Creating from a Functional Modeling Part Pattern

You can create a complex Assembly Feature from a Functional Plastic Parts feature, for example a pattern of tapped holes.

This capability is based on the Functional Plastic Parts Local Modifier concept.

As local modifiers, which can be chained, do not change the type (Hole, Added or Protected) of the initial functional features, they can be used to create more complex Assembly Features. See Functional Plastic Parts User's Guide: Creating Dress-up and Modifier Features: Creating Dress-Up and Modifier features: Basic Concepts: About Feature Modifiers .

Before you begin: Open an assembly containing a Functional Plastic Parts pattern of tapped holes in a representation where Technological Results have been generated.

  1. From the Assembly section of the action bar, click Assembly Feature .
    The Assembly Features dialog box appears.
  2. Select the Functional Plastic Parts pattern specification in the tree.
    Rectangular Pattern.1 name is displayed in the Shape box.
  3. Select the representation in the tree that will be affected by the pattern: ASD_Block_Representation.
  4. Click OK in the Assembly Features dialog box.
    • An Assembly Feature node is created under the active product, and containing an Assembly Hole feature.
    • The contextual symbol appears on the affected representation: .
  5. From the standard area of the action bar, click Update .
    The pattern of tapped holes is applied on the affected representation.

  6. Double-click the affected representation in order to switch in Part Design app.

    Note:

    • Double-clicking a representation in the tree lets you switch to the last recently opened representation app.
    • If needed, from the Compass, click 3D Modeling Apps and select Part Design.

  7. Right-click the PartBody of the affected representation and select Create Technological Results... from the contextual menu.
    A Technological Results node is created under the PartBody of the affected representation. This node contains all features needed to define the pattern of tapped holes in the affected representation: hole and thread features.
  8. From the Review section of theaction bar, click Tap - Thread Analysis .
    The Thread/Tap Analysis dialog box appears.
    Note: 16 taps have been detected.
  9. Click Apply in the Thread/Tap Analysis dialog box.
    Tapped hole information is displayed.

  10. Click OK in the Thread/Tap Analysis dialog box.
  11. Double-click the root product to back in Assembly Design app if needed.