Creating a Point Using Coordinates

You can create a point by defining the coordinates from a reference point.

Before you begin: Insert in an assembly an existing 3D shape containing geometric elements.
  1. From the Assembly section of the action bar, click Point .
    The Choose a 3D Shape dialog box appears.
  2. Click Create new in the Choose a 3DShape dialog box.

    In the Choose a 3D Shape dialog box:

    • The Product box displays the name of the active product.
    • 3DShapes either lists the available 3D shapes instanced under the active product or lists the available 3D shapes instanced under a selected product. In both cases, these 3D shapes can be modified.
    • The Create new command allows you to create a 3D shape.
      Important: When you create a new 3D shape in Assembly commands context, its Nature is set as Specification whatever your choice in the dialog box, and you cannot change the nature of this 3D shape after it has been created with this command. See Nature of a New 3D Shape Created in Assembly Commands Context.
    • The Automatically create new 3D Shape when none exists option allows you to create a 3D shape either under the active or selected product automatically. In this case, the Choose a 3D Shape dialog box does not appear.

    The New Content tab appears.
  3. Click 3D Shape under Physical Product Structure node in the New Content tab.
  4. Click OK in the 3D Shape dialog box.
    The new 3D Shape is created under the active product.
  5. Click OK in the 3D Shape dialog box.
    • The new 3D Shape is created under the active product.
    • The Axis System Definition dialog box appears. The axis system's parameters Origin, X axis, Y axis, and Z axis are automatically computed, and Default (Computed) appears in the boxes.
  • Important: You switch from Assembly Design app to the last representation app you used.
    1. Select Coordinates.
    2. In the X, Y and Z box, type the coordinate value or use the arrows to change the value.
    3. Optional: In the Reference point box, select a reference point.
      When the command is launched at creation, the initial value in the Axis System box is the current local axis system. If no local axis system is current, the box is set to Default.

      Whenever you select a local axis system, the point's coordinates are changed with respect to the selected axis system so that the location of the point is not changed. This is not the case with points valuated by formulas, that is, if you select an axis system, the defined formula remains unchanged.

      Important:
      • If you create a point using the coordinates method and an axis system is already defined and set as current, the point's coordinates are defined according to the current axis system.
      • The current local axis system must be different from the absolute axis.
    4. Click Robot Location.
      If the Robot is lying on the geometry, the X, Y, and Z coordinates of the point are modified according to the location of the Robot. However, if the Robot is not lying on the geometry, that is, if it is at the default location, clicking this button displays an error message, and the point is created using existing specified coordinates.
      Important: The Robot Location option is unavailable when any of the X, Y, or Z coordinate is specified using a formula.
    5. Click OK to create the point.
      The point (identified as Point.xxx) is added to the tree.
      Important: You come back in the Assembly Design app.