| Assembly Constraints
|
Converted as engineering connection constraints
and regrouped into engineering connections.
|
Partially Imported:
- V5 constraints names are imported.
When a V5 constraint has no name, a name based on the
constraint type and digits is created.
- V5 constraints related to the same component are now grouped in
an engineering connection.
The engineering connection type is detected and locked
automatically (if the
Lock automatically the engineering connection type
at validation option is selected in
.
- Sector in Angle Constraint:
- Sector option associated with an angle value is not
imported.
- When the angle value is defined with another sector than
Sector 1, the angle value is modified to keep instance positions.
- When the angle value is involved or driven in a formula, a
warning message asks the user to check the value. This is true only if the
formula is imported too, otherwise only the imported angle value is taken into
account.
- Point Contact, Line Contact, Surface Contact and Annular
Contact are converted as contact constraints.
- Fix Together with N instances is converted as a Fix Together
constraint in a single Rigid engineering connection.
- Fix Together of Fix together is converted as Rigid engineering
connections of Fix Together.
- Constraint sets are not imported.
Notes:
- At the end of the import, engineering connections are
synchronized and their statuses updated.
- Engineering connections group all constraints related to
a given couple of instances, which is the most frequent use of a constraint
set. Such an engineering connection can be seen as an automatic and smart
constraint set.
|
| Assembly Symmetry
|
Assembly
|
Partially Imported
- Mirror, new component:
- Imported as
New Reference for product that does
not contain a 3DShape.
- Imported as
Existing Reference for product
containing a 3DShape.
- Rotation, new instance: imported as
Same Reference type.
- Rotation, same instance: not imported
- Translation, new instance:
- The original instance is imported as
No Symmetric.
- The symmetric instance is imported as
No original.
- xy plane, yz plane, zx plane: imported, plane information are
stored in
Geometry connection and
Fix Symmetrically engineering connections
if needed.
- Keep link in position:
Fix Symmetrically and
Symmetry engineering connections are
created if
Keep link in position is defined.
- Positioning plane definition:
Fix Symmetrically and
Symmetry engineering connections are
created if a Positioning plane and
Keep link in position are defined.
- When
Automatically solve structure differences
is specified a structure connection is created:
- Deleted original instance:
The symmetric instance is imported as
No original.
- Deleted Symmetric instance:
The original instance is imported as
No Symmetric.
- Inserted original instance:
The original instance is imported as
No Symmetric.
- Inserted symmetric instance:
The symmetric instance is imported as
No original.
- Replaced original instance:
The symmetric instance is imported as
Existing Reference.
- Replaced symmetric instance:
The symmetric instance is imported as
Existing Reference.
- Keep link with geometry: concerned bodies are imported as
result with links if
Keep link with geometry is defined,
imported as result otherwise.
- Geometry creation filtering: concerned bodies are imported.
|
| Assembly Pattern
|
Assembly
|
Partially Imported:
- Assembly Pattern specifications are imported when:
- Keep Link with the pattern option is
selected.
- Pattern's definition option is
selected.
- Assembly Pattern specifications are not imported when:
|
| Assembly Features (Add, Remove, Hole, Split,
Pocket)
|
Assembly
|
Partially Imported
- Using the
As result option:
- Assembly Feature specifications are not imported.
- Operations which result from the use of Assembly Features
are kept.
- V5 feature impacts are converted in
3DEXPERIENCE
feature impacts, they are no longer connected but they can be edited. An arrow
is added on the icon of the
tree
to identified them.
- Using the
As specification option:
- V5 Assembly Feature names are not imported.
- A Specification 3D Shape is created under the parent
product of the Assembly Feature and containing the Assembly Feature
specification. A link is created between this shape and the
3DEXPERIENCE
Assembly Feature.
- An
External References shape is created
under the parent product of the Assembly Feature and containing the Assembly
Feature inputs
- Functional Assembly Features can be created under the
current body set as
Defined In Work:
- The current body can be the Partbody or a solid body.
- If the current body is a
Geometrical Set or an
Ordered Geometrical Set, the
Partbody will be selected.
- If the current body does not belong to a solid body, no
body is impacted.
- Affected V5 part references are identified as impacted
shapes after the migration.
- When a V5 Assembly Feature impacts several instances of
a V5 part, a unique impact is created in the part reference in context of a
single instance.
Notes:
- V5 Assembly Hole:
- V5
Up to Plane extension option,
the limit plane will be copied in the
External References shape.
- V5
Up to Last extension option is
not supported, the
3DEXPERIENCE
Blind option will be applied,
the depth will be the maximum of all the impacts.
- V5
Depth & Diameter and
Angle & Diameter countersunk
options are replaced by
Depth and Angle option.
- V5
Countersunk Diameter
counterdrilled option is switched to
No Countersunk Diameter option.
- V5 counterbored standards are not migrated and
No standard option is applied.
- V5
Support Depth and
Up-To-Plane options of thread
definition are replaced by
Dimension option.
- V5 thread definition type standards are not migrated
and
No standard option is applied.
|
| Flexible assembly
|
Assembly
|
Partially Imported
In V5, the flexibility status is
defined on a product instance. Defining that a product instance is flexible
does not affect the other instances of this product.
In
3DEXPERIENCE,
the flexibility status is defined on the original product. Defining flexibility
on a product means that all its instances are flexible. This product becomes a
PMR (Positional Mechanical Reference).
Two consequences for the import:
- V5 flexible product instances can have overloaded positions in
3DEXPERIENCE,
different from the one defined on the other imported product instances.
- The imported original product is not necessarily defined as PMR.
|
| Product graphical properties
|
Product graphical properties
|
Fully Imported
|
