PP Tables and Word Syntaxes

Parameterized Syntax

This is an example of parameterized syntax

            *START_NC_COMMAND     NC_COMPENSATION
            LOADTL/%MFG_TL_NUMBER,%MFG_TOOL_COMP
            *END

Notes:

The & character indicates a list and the % character indicates a parameter.
A list has a finite number of values.
You can define only one syntax for each NC command.

The examples below show how lists are used to define units for feeds and speeds.

Example: Defining Inch Units for Feeds and Speeds

                *START_NC_COMMAND
                NC_FEEDRATE
                *START_LIST MFG_FEED_UNIT
                IPM ,IPR
                *END
                FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
                *END
                /
                *START_NC_COMMAND         NC_SPINDLE_START
                *START_LIST MFG_SPNDL_UNIT
                RPM ,SFM
                *END
                SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
                *END
                /
                *START_NC_COMMAND         NC_SPINDLE_LATHE
                *START_LIST MFG_SPNDL_UNIT
                RPM ,SFM
                *END
                SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
                *END

Example: Defining Metric Units for Feeds and Speeds

                *START_NC_COMMAND
                NC_FEEDRATE
                *START_LIST MFG_FEED_UNIT
                MMPM ,MMPR
                *END
                FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT
                *END
                /
                *START_NC_COMMAND         NC_SPINDLE_START
                *START_LIST MFG_SPNDL_UNIT
                RPM ,SMM
                *END
                SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY
                *END
                /
                *START_NC_COMMAND         NC_SPINDLE_LATHE
                *START_LIST MFG_SPNDL_UNIT
                RPM ,SMM
                *END
                SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT
                *END

Arithmetic Operators

You can use the following arithmetic operators in PP word syntaxes:

addition (+)
subtraction (-)
multiplication (*)
division (/).

These operators are used between:

word syntaxes (for example, %MFG_xxx + %MFG_yyy)
a value and a word syntax (for example, n + %MFG_yyy)
a word syntax and a value (for example, %MFG_xxx + n)
values (for example, n + m).

Parenthesis are not needed in expressions: they are ignored and cannot appear in NC data output. For example:

WORD/%MFG_aaa, %MFG_xxx + %MFG_yyy, %MFG_bbb/2

Operators are processed in the order they appear in the syntax: the example below means that %MFG_xxx is added to %MFG_yyy, then this sum is multiplied by %MFG_zzz.

%MFG_xxx + %MFG_yyy * %MFG_zzz

Note: Avoid using the +, -, *, / characters for other meanings. For example, use an underscore (_) instead of a dash (-) in the following expression to avoid any ambiguity:

PPRINT/DIAMETER-VALUE, %MFG_NOMINAL_DIAM

Start Comments

You can use NC_xxx_MO_START_COMMENT syntaxes to generate machining operation information in the APT source file. A sample PP table (PPtableSampleMOComment.pptable) is delivered in the ..\startup\manufacturing\PPtables folder.

NC_AXIAL_MO_START_COMMENT

For axial machining operations:

                *START_NC_INSTRUCTION NC_AXIAL_MO_START_COMMENT
                *START_SEQUENCE
                PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT PATTERN NAME = %MFG_PATTERN_NAME
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_AXIAL_MO_START_COMMENT END
                *END
                *END

The following example shows the type of APT source that is generated:

                  PPRINT NC_AXIAL_MO_START_COMMENT BEGIN
                  PPRINT MACHINE OPERATION = Drilling
                  PPRINT OPERATION NAME = Drilling.1
                  PPRINT PATTERN NAME = Hole.1
                  PPRINT TOOL ASSEMBLY = Drill_Diam10
                  PPRINT NC_AXIAL_MO_START_COMMENT END
                  PPRINT OPERATION NAME : Drilling.1
                  $$ Start generation of : Drilling.1
                  LOADTL/2,1
                  SPINDL/ 204.0000,SFM,CLW
                  RAPID
                  GOTO / 130.00000, -55.00000, 2.50000
                  CYCLE/DRILL, 52.886751, 2.500000, 0.200000,MMPR
                  GOTO / 130.00000, -55.00000, 0.00000
                  CYCLE/OFF

NC_3X_MO_START_COMMENT

For 3-axis milling operations:

                *START_NC_INSTRUCTION NC_3X_MO_START_COMMENT
                *START_SEQUENCE
                PPRINT NC_3X_MO_START_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_3X_MO_START_COMMENT END
                *END
                *END

NC_5X_MO_START_COMMENT

For 5-axis milling operations:

                *START_NC_INSTRUCTION NC_5X_MO_START_COMMENT
                *START_SEQUENCE
                PPRINT NC_5X_MO_START_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_5X_MO_START_COMMENT END
                *END
                *END

NC_LATHE_MO_START_COMMENT

For turning operations:

                *START_NC_INSTRUCTION NC_LATHE_MO_START_COMMENT
                *START_SEQUENCE
                PPRINT NC_LATHE_MO_START_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_LATHE_MO_START_COMMENT END
                *END
                *END

NC_MILL_MO_START_COMMENT

For 2.5-axis milling operations:

                *START_NC_INSTRUCTION NC_MILL_MO_START_COMMENT
                *START_SEQUENCE
                PPRINT NC_MILL_MO_START_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_MILL_MO_START_COMMENT END
                *END
                *END

End Comments

You can use NC_xxx_MO_END_COMMENT syntaxes to generate automatically instructions in the APT output at the end of a machining operation (stop spindle rotation, stop coolant, axis locking / unlocking, deactivating a working mode, and so on) and to easily recognize the end of operations. This allows the PP to stop reading ahead of the APT if it is searching an instruction only inside the current operation, for example. This avoids the need to manually insert APT words, which is not always possible.

NC_AXIAL_MO_END_COMMENT

For axial machining operations:

                *START_NC_INSTRUCTION NC_AXIAL_MO_END_COMMENT
                *START_SEQUENCE
                PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT PATTERN NAME = %MFG_PATTERN_NAME
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_AXIAL_MO_END_COMMENT END
                *END
                *END

The following example shows the type of APT source that is generated:

                  $$ End generation of : Drilling.1
                  PPRINT NC_AXIAL_MO_END_COMMENT BEGIN
                  PPRINT MACHINE OPERATION = Drilling
                  PPRINT OPERATION NAME = Drilling.1
                  PPRINT PATTERN NAME = Hole.1
                  PPRINT TOOL ASSEMBLY = Drill_Diam10
                  PPRINT NC_AXIAL_MO_END_COMMENT END
                  PPRINT OPERATION NAME : Drilling.1

NC_3X_MO_END_COMMENT

For 3-axis milling operations:

                *START_NC_INSTRUCTION NC_3X_MO_END_COMMENT
                *START_SEQUENCE
                PPRINT NC_3X_MO_END_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_3X_MO_END_COMMENT END
                *END
                *END

NC_5X_MO_END_COMMENT

For 5-axis milling operations:

                *START_NC_INSTRUCTION NC_5X_MO_END_COMMENT
                *START_SEQUENCE
                PPRINT NC_5X_MO_END_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_5X_MO_END_COMMENT END
                *END
                *END

NC_LATHE_MO_END_COMMENT

For turning operations:

                *START_NC_INSTRUCTION NC_LATHE_MO_END_COMMENT
                *START_SEQUENCE
                PPRINT NC_LATHE_MO_END_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_LATHE_MO_END_COMMENT END
                *END
                *END

NC_MILL_MO_END_COMMENT

For 2.5-axis milling operations:

                *START_NC_INSTRUCTION NC_MILL_MO_END_COMMENT
                *START_SEQUENCE
                PPRINT NC_MILL_MO_END_COMMENT BEGIN
                PPRINT MACHINE OPERATION = %MFG_MO_TYPE
                PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER
                PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID
                PPRINT NC_MILL_MO_END_COMMENT END
                *END
                *END

Drilling Riveting


NC Commands	Comments
`NC_DR_MO_START_COMMENT`	Output at the start of a Drilling Riveting MO. PP Word Syntax: START_NC_INSTRUCTION NC_DR_MO_START_COMMENT START_SEQUENCE PPRINT NC_DR_MO_START_COMMENT BEGIN PPRINT MACHINE OPERATION = %MFG_MO_TYPE PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER PPRINT NC_DR_MO_START_COMMENT END END END
`NC_DR_MO_END_COMMENT`	Output at the end of a Drilling Riveting MO. PP Word Syntax: START_NC_INSTRUCTION NC_DR_MO_END_COMMENT START_SEQUENCE PPRINT NC_DR_MO_END_COMMENT BEGIN PPRINT MACHINE OPERATION = %MFG_MO_TYPE PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER PPRINT NC_DR_MO_END_COMMENT END END END
`NC_INSTRUCTIONSET_START`	Output at the start of an Instruction Set. PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_START START_SEQUENCE PPRINT NC_INSTRUCTIONSET_START END END
`NC_INSTRUCTIONSET_END`	Output at the end of an Instruction Set. PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_END START_SEQUENCE PPRINT NC_INSTRUCTIONSET_END END END
`NC_INSTRUCTIONSET_MOVE_START`	Output at start for each move action of an Instruction Set. PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_MOVE_START START_SEQUENCE PPRINT NC_INSTRUCTIONSET_MOVE_START END END
`NC_INSTRUCTIONSET_MOVE_END`	Output at end for each move action of a Instruction Set. PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_MOVE_END START_SEQUENCE PPRINT NC_INSTRUCTIONSET_MOVE_END END END
`NC_INSTRUCTIONSET_DEVICEMOVE_START`	Output at start for each device in a move action of an Instruction Set. PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_DEVICEMOVE_START START_SEQUENCE PPRINT NC_INST_DEVICEMOVE_START = %MFG_DEVICE_NAME END END
`NC_INSTRUCTIONSET_DEVICEMOVE_END`	Output at end for each device in a move action of an Instruction Set.PP Word Syntax: START_NC_INSTRUCTION NC_INSTRUCTIONSET_DEVICEMOVE_END START_SEQUENCE PPRINT NC_INST_DEVICEMOVE_END = %MFG_DEVICE_NAME END END
`NC_INSTRUCTIONSET_AXIS_MOVE`	Output for each axis of a device in a move action of an Instruction Set. PP Word Syntax: START_NC_COMMAND NC_INSTRUCTIONSET_AXIS_MOVE START_LIST MFG_AXIS_MOVE_TYPE ABS,INCR END MOVE/%MFG_AXIS_NAME,&MFG_AXIS_MOVE_TYPE,%MFG_AXIS_POSITION END
`NC_INSTRUCTIONSET_AXIS_FEEDRATE`	Output for each axis feed rate of a device in a move action of an Instruction Set. PP Word Syntax: START_NC_COMMAND NC_INSTRUCTIONSET_AXIS_FEEDRATE START_LIST MFG_AXIS_FEED_UNIT MMPM ,MMPR END INST_FED/%MFG_AXIS_FEED_VALUE,&MFG_AXIS_FEED_UNIT END
`NC_INSTRUCTIONSET_DWELL`	Output for each dwell action of an Instruction Set. PP Word Syntax: START_NC_COMMAND NC_INSTRUCTIONSET_DWELL DELAY/%MFG_DELAY_VALUE END
`NC_INSTRUCTIONSET_PUBLIC_PARAM`	Output for each public parameter of the Approach and Fastening instruction sets at the start of a drilling and riveting operation, or for a specific instruction set. START_NC_INSTRUCTION NC_INSTRUCTIONSET_PUBLIC_PARAM START_SEQUENCE PPRINT %MFG_IS_PUBLIC_PARAM_NAME,%MFG_IS_PUBLIC_PARAM_TYPE,%MFG_IS_PUBLIC_PARAM_VALUE,%MFG_IS_NAME,%MFG_IS_TYPE END END

Robots


NC Commands	Comments
`NC_DEVICE_MOTION_TYPE`	Output for the robot motion type, for each Cartesian point. START_NC_INSTRUCTION NC_DEVICE_MOTION_TYPE START_SEQUENCE MOTIONTYPE/%MFG_MOTION_TYPE END END
`NC_DEVICE_CONFIG`	Output for the configuration numbers, for each Cartesian point. START_NC_INSTRUCTION NC_DEVICE_CONFIG START_SEQUENCE CONFIG/%MFG_CONFIG_NUMBER END END
`NC_JOINT_TURN`	Output for the turn number (if defined), for each Cartesian point. START_NC_INSTRUCTION NC_JOINT_TURN START_SEQUENCE TURN/%MFG_TURN_NUMBER1,%MFG_TURN_NUMBER2,%MFG_TURN_NUMBER3,%MFG_TURN_NUMBER4,%MFG_TURN_NUMBER5 END END
`NC_JOINTS_MOVE`	Output for the DOF information, for each Cartesian point. START_NC_INSTRUCTION NC_JOINT_MOVE START_SEQUENCE JOINT/%MFG_JOINT_VALUE1,%MFG_JOINT_VALUE2,%MFG_JOINT_VALUE3,%MFG_JOINT_VALUE4,%MFG_JOINT_VALUE5,%MFG_JOINT_VALUE6 END END


NC Parameters	Comments
`MFG_MOTION_TYPE`	Type of the robot motion. The value is set to 1 or 2 depending whether the motion type is linear or joint. The parameter type is integer.
`MFG_CONFIG_NUMBER`	Value of the configuration. The parameter type is integer.
`MFG_TURN_NUMBERn` Where n = 1,2,3...	Turn number of joint (if defined). It is similar to the number displayed in the Multi-Motions Editor. The parameter type is a string.
`MFG_JOINT_VALUEn` Where n = 1,2,3...	Value of the n^th DOF of the entire robotic cell. The parameter type is real.

Other NC Commands and Parameters

Note: Parameters listed under a context have to be used in the same context and should not be extended to other contexts.


NC Commands and Parameters	Comments
`NC_AXIS_LOCK`	Allows blocking a linear or rotary axis. See Displacing and Locking Linear and Rotary Axes.
`MFG_AXIS_LOCK_STATUS`	Defines the lock status of the NC axis.
`MFG_NCAXIS_NAME`	Defines the name of NC axis.
`NC_AXIS_MOVE`	Allows linear displacement. See Displacing and Locking Linear and Rotary Axes.
`MFG_NCAXIS_NAME`	Defines the name of the NC axis.
`MFG_AXIS_POSITION`	Defines the position of the NC axis
`NC_CHANGE_REF_PT`	Defines the tool compensation corresponding to the desired tool output point.
`MFG_QUADRANT`	Defines the number of the compensation type (for example, 2 for compensation type P2).
`MFG_NOSE_RADIUS`	Defines the insert nose radius.
`MFG_TL_SET_X`	Defines the tool assembly set length in x direction.
`MFG_TL_SET_Y`	Defines the tool assembly set length in y direction.
`MFG_TL_SET_Z`	Defines the tool assembly set length in z direction.
`MFG_LGTH_COR_REG`, `MFG_TOOL_COMP` `MFG_TL_COMP`	Define the number of the correction register.
`MFG_ID_COMP`	Define the number of the corrector ID

By default, the syntax is:

SWITCH/% MFG_QUADRANT

Syntax example for turning operations:

            SWITCH/%MFG_TL_COMP,%MFG_QUADRANT,INCR,%MFG_TL_SET_X,
            %MFG_TL_SET_Z,%MFG_NOSE_RADIUS


NC Commands and Parameters	Comments
`NC_COMMENT`
`MFG_MO_COMMENT`	Defines the comment on the Machining Operation.

By default, the syntax is

% MFG_MO_COMMENT


NC Commands and Parameters	Comments
`NC_COMPENSATION`
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TL_COMP_RAD`	Defines the tool compensation radius.
`MFG_TL_NUMBER`	Defines the tool number associated to the compensation.
`MFG_TL_NAME`	Defines the name of tool associated to the compensation.

By default, the syntax is

LOADTL/% MFG_TL_NUMBER ,%MFG_TL_COMP


NC Commands and Parameters	Comments
`NC_CUTCOM_ON`	The syntax of this NC command is `CUTCOM/ON` and cannot be parameterized.
`NC_CUTCOM_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_NORMDS_ON`	The syntax of this NC command is `CUTCOM/SAME, NORMDS` and cannot be parameterized.
`NC_CUTCOM_NORMDS_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_NORMPS_ON`	The syntax of this NC command is `CUTCOM/NORMPS` and cannot be parameterized.
`NC_CUTCOM_NORMPS_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_LEFT`	The syntax of this NC command is `CUTCOM/LEFT` and cannot be parameterized.
`NC_CUTCOM_RIGHT`	The syntax of this NC command is `CUTCOM/RIGHT` and cannot be parameterized.


NC Commands and Parameters	Comments
`NC_DELAY`
`MFG_DELAY_UNIT`	Defines the delay units from two values: First value: delay expressed in number of revolutions. By default, the value is `REV`. Second value: delay expressed in seconds. By default, the value is a blank string (represented by 8 underscore characters). When the statement is generated by the app this string is ignored.
`MFG_DELAY_VALUE`	Defines the numerical value of the delay.

By default, the syntax is

DELAY/%MFG_DELAY_VALUE,&MFG_DELAY_UNIT


NC Commands and Parameters	Comments
`NC_FEEDRATE`
`MFG_FEED_UNIT`	Defines the feedrate unit. This is done from a list with two values: First value: feedrate expressed in model units per minute. By default, the value is `MMPM` Second value: feedrate expressed in model units per revolution. By default, the value is `MMPR`
`MFG_FEED_VALUE`	Defines the numerical value of the feedrate.

By default, the syntax is

FEDRAT/% MFG_FEED_VALUE,&MFG_FEED_UNIT


NC Commands and Parameters	Comments
`NC_MACHINING_AXIS`
`MFG_NCAXIS_IDENTIFIER`	See Displacing and Locking Linear and Rotary Axes Defines the NC-Axis identifiers, as the name of the Manufacturing Program for the first output, otherwise as the name of the machining axis change.
`MFG_SPINDLE_NAME`	Defines the name of the spindle that is linked to the origin.
`MFG_SPINDLE_NUMBER`	Defines the number of the spindle that is linked to the origin.
`MFG_NCAXIS_X_ORIG` `MFG_NCAXIS_Y_ORIG` `MFG_NCAXIS_Z_ORIG`	Defines the coordinates of the machining axis origin.
`MFG_NCAXIS_X_VECX` `MFG_NCAXIS_Y_VECX` `MFG_NCAXIS_Z_VECX`	Defines the components of the x-axis.
`MFG_NCAXIS_X_VECY` `MFG_NCAXIS_Y_VECY` `MFG_NCAXIS_Z_VECY`	Defines the components of the y-axis.
`MFG_NCAXIS_X_VECZ` `MFG_NCAXIS_Y_VECZ` `MFG_NCAXIS_Z_VECZ`	Defines the components of the z-axis.

By default, the syntax is

            $$*CATIA0
            $$ %MFG_NCAXIS_IDENTIFIER
            $$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ
            %MFG_NCAXIS_X_ORIG
            $$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY
            %MFG_NCAXIS_Y_VECZ
            %MFG_NCAXIS_Y_ORIG
            $$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ
            %MFG_NCAXIS_Z_ORIG


NC Commands and Parameters	Comments
`NC_MULTAX_ON`	The syntax of this NC command is `MULTAX` and cannot be parameterized.
`NC_MULTAX_OFF`	The syntax of this NC command is `MULTAX/OFF` and cannot be parameterized.


NC Commands and Parameters	Comments
`NC_PITCH`
`MFG_THREAD_PITCH`	Defines the thread pitch.
`MFG_NUM_THREADS`	Defines the number of threads.

Syntax examples:

            PITCH/%MFG_THREAD_PITCH

            PITCH/(1/%MFG_THREAD_PITCH),MULTRD,%MFG_NUM_THREADS
            FEDRAT/%MFG_THREAD_PITCH,MMPR


NC Commands and Parameters	Comments
`NC_SPINDLE_ON`	The syntax of this NC command is `SPINDL/ON` and cannot be parameterized.
`NC_SPINDLE_START` `NC_SPINDLE`
`MFG_SPNDL_UNIT`	Defines the spindle speed unit. This is done from a list with two values: First value: spindle rotation expressed in revolutions per minute. By default, the value is `RPM.` Second value: spindle rotation expressed in surface meters per minute. By default, the value is `SMM.`
`MFG_SPNDL_WAY` `MFG_SPINDL_WAY`	Defines the spindle direction. This is done from a list with two values: First value: spindle rotation processed clockwise. By default, the value is `CLW.` Second value: spindle rotation processed counter-clockwise. By default, the value is `CCLW.`
`MFG_SPNDL_SPEED`	Defines the numerical value of the spindle speed.
`MFG_SPNDL_DIAMTR`	Defines the diameter of the tool where the spindle speed is taken into account.
`NC_SPINDLE_LATHE`	Corresponds to the part spindle speed.
`NC_SPINDLE_STOP`	Note: this NC command is available to allow compatibility with previous versions. However, whenever possible, use `NC_SPINDLE_LOCK` or `NC_SPINDLE_OFF` instead of `MFG_SPNDL_STOP`.
`MFG_SPNDL_STOP`	List with two values defining the action applied to the spindle: First value: de-activation of the spindle. By default, the value is `OFF.` Second value: spindle locked in an indexed position. By default, the value is `LOCK.`
`NC_SPINDLE_LOCK`	The syntax of this NC command is `SPINDL/LOCK` and cannot be parameterized.
`NC_SPINDLE_OFF`	The syntax of this NC command is `SPINDL/OFF` and cannot be parameterized.

By default, the syntax is

            SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,
            &MFG_SPNDL_WAY


NC Commands and Parameters	Comments
`NC_THREAD_TURN`
`NC_THREAD_TURN_OFF`	Ends a `NC_THREAD_TURN` statement.

Syntax examples

THREAD/TURN

            *START_NC_COMMAND
            NC_THREAD_TURN_OFF
            THREAD/OFF
            *END

NC Commands for Tool Path Repetition


NC Commands	Comments
`NC_REPETITION_BLOCK_START`	Defines the start index of the block. By default, the syntax is: START_NC_INSTRUCTION NC_REPETITION_BLOCK_START START_SEQUENCE BLOCK/%MFG_REPEAT_INDEX END END
`NC_REPETITION_BLOCK_END`	Defines the end index of the block. By default, the syntax is: START_NC_INSTRUCTION NC_REPETITION_BLOCK_END START_SEQUENCE BLOCK/%MFG_REPEAT_INDEX,NOMORE,%MFG_REPEAT_POSITION_COUNT,%MFG_REPEAT_TYPE END END
`NC_REPETITION_DEFINE`	Outputs the information of a block (sub-program) definition. By default, the syntax is: START_NC_INSTRUCTION NC_REPETITION_DEFINE START_SEQUENCE DEFCOPY/%MFG_REPEAT_INDEX,AXIS,%MFG_REPEAT_IS_REFERENCE,$ (MATRIX/%MFG_REPEAT_X_VECX,%MFG_REPEAT_Y_VECX,%MFG_REPEAT_Z_VECX,%MFG_REPEAT_X_ORIG, %MFG_REPEAT_X_VECY,%MFG_REPEAT_Y_VECY,%MFG_REPEAT_Z_VECY,%MFG_REPEAT_Y_ORIG, %MFG_REPEAT_X_VECZ,%MFG_REPEAT_Y_VECZ,%MFG_REPEAT_Z_VECZ,%MFG_REPEAT_Z_ORIG) END END
`NC_REPETITION_COPY`	Outputs the information of a block (sub-program) call. By default, the syntax is: START_NC_INSTRUCTION NC_REPETITION_COPY START_SEQUENCE COPY/%MFG_REPEAT_INDEX,AXIS,%MFG_REPEAT_IS_REFERENCE,$ (MATRIX/%MFG_REPEAT_X_VECX,%MFG_REPEAT_Y_VECX,%MFG_REPEAT_Z_VECX,%MFG_REPEAT_X_ORIG, %MFG_REPEAT_X_VECY,%MFG_REPEAT_Y_VECY,%MFG_REPEAT_Z_VECY,%MFG_REPEAT_Y_ORIG, %MFG_REPEAT_X_VECZ,%MFG_REPEAT_Y_VECZ,%MFG_REPEAT_Z_VECZ,%MFG_REPEAT_Z_ORIG) END END

For more information on tool path repetition NC instructions, see NC Instructions for Tool Path Repetition.

PP Tables and Word Syntaxes - NC Commands

Parameterized Syntax

Arithmetic Operators

Start Comments

End Comments

Drilling Riveting

Robots

Other NC Commands and Parameters

NC Commands for Tool Path Repetition