Whole Element Variables

You can request whole element variable output to the results or output database file.

This page discusses:

See Also
Element Output
Writing Element Output to the Output Database

The output variables listed below are available in Abaqus/Explicit.

ELEN
Field: yes  History: yes  .fil: yes  

All energy magnitudes in the element.

ELSE
Field: yes  History: yes  .fil: no  

Total elastic strain energy in the element (includes energy in transverse shear deformation in shells).

ELCD
Field: yes  History: yes  .fil: no  

Total energy dissipated in the element by viscoelastic deformation. (Not supported for hyperelastic and hyperfoam material models with linear viscoelasticity.)

ELPD
Field: yes  History: yes  .fil: no  

Total energy dissipated in the element by rate-independent and rate-dependent plastic deformation. For superelastic materials, this variable also includes recoverable phase-transformation energy.

ELVD
Field: yes  History: yes  .fil: no  

Total energy dissipated in the element by viscous effects. This includes bulk viscosity and material damping.

ELASE
Field: yes  History: yes  .fil: no  

Total “artificial” strain energy in the element. This includes hourglass energy and drilling stiffness energy in shells.

ELIHE
Field: yes  History: yes  .fil: no  

Internal heat energy in the element.

ELDMD
Field: yes  History: yes  .fil: no  

Total energy dissipated in the element by damage.

ELDC
Field: yes  History: yes  .fil: no  

Total energy dissipated in the element by distortion control.

ELEDEN
Field: yes  History: no  .fil: no  

All element energy density components.

ESEDEN
Field: yes  History: no  .fil: no  

Total elastic strain energy density in the element.

EPDDEN
Field: yes  History: no  .fil: no  

Total energy dissipated per unit volume in the element by rate-independent and rate-dependent plastic deformation.

ECDDEN
Field: yes  History: no  .fil: no  

Total energy dissipated per unit volume in the element by viscoelasticity.

EVDDEN
Field: yes  History: no  .fil: no  

Total energy dissipated per unit volume in the element by viscous effects.

EASEDEN
Field: yes  History: no  .fil: no  

Total “artificial” strain energy density in the element (energy associated with constraints used to remove singular modes, such as hourglass control).

EIHEDEN
Field: yes  History: no  .fil: no  

Internal heat energy density in the element.

EDMDDEN
Field: yes  History: no  .fil: no  

Total energy dissipated per unit volume in the element by damage.

EDCDEN
Field: yes  History: no  .fil: no  

Total energy dissipated per unit volume in the element by distortion control.

EDT
Field: yes  History: yes  .fil: yes  

Element stable time increment.

EMSF
Field: yes  History: yes  .fil: yes  

Element mass scaling factor.

STATUS
Field: yes  History: yes  .fil: yes  

Status of the element (material failure with progressive damage, shear failure model, tensile failure model, porous failure criterion, brittle failure model, Johnson-Cook plasticity model, and VUMAT). The status of an element is 1.0 if the element is active, 0.0 if the element is not.

The status output is added automatically by the analysis.

EVOL
Field: yes  History: yes  .fil: no  

Current element volume. (Only available for continuum and structural elements not using general beam or shell section definitions.)

NFORC
Field: yes  History: yes  .fil: no  

Forces at the nodes of an element from both the hourglass and the regular deformation modes of that element (negative of the internal forces in the global coordinate system).

GRAV
Field: yes  History: no  .fil: no  

Uniformly distributed gravity load (measured as g, where g is the gravitational acceleration).

SBF
Field: yes  History: no  .fil: no  

Stagnation body force.

BF
Field: yes  History: no  .fil: no  

Uniformly distributed body force, including viscous body force.

EDMICRTMAX
Field: yes  History: no  .fil: no  

Whole shell element maximum damage initiation output among all of the layers, all of the damage initiation criteria, and for fully integrated elements across all of the integration points.

This output variable is the same as DMICRTMAX output for solid and beam elements but complements the DMICRTMAX output variable for composite shell elements because it extracts the maximum damage initiation across all of the layers.

This output variable generates four element output quantities as follows:

EDMICRTMAXVAL outputs the maximum damage initiation value in the entire element.

EDMICRTLAYER outputs the layer number in which the maximum damage initiation value occurred.

EDMICRTTYPE outputs a value that represents the damage initiation criteria type that reached the maximum value in the element, as described in the DMICRTMAX output variable description.

EDMICRTINTP outputs the integration point number for which the maximum damage value occurred. For reduced-integration elements, the output value is one.

The maximum damage initiation output values are retained across the requested output frames until a higher maximum damage initiation value is computed.