Creating Path Segment Members

Path structure members are made of sketch elements and are useful in creating the basic framework of a structure system.

Before you begin:
  1. From the Tools section of the action bar, click Update Standard Section Library to update the profile library.
  2. From the Structure section of the action bar, click Structure Section Manager to create a standard or custom profile. See Creating Structure Sections, Creating Custom Sections.
  3. Create a sketch using sketch segments, edges, or curves.

  1. From the Structure section of the action bar, click Path Segment Member .
  2. In the work area, select a segment, curve, or an edge.

    Alternatively, do one of the following.

    • In the work area, right-click a sketch element and from the context toolbar, click Path Segment Member .
    • From the Design Manager Tree, select a sketch, and from the context toolbar, click Path Segment Member .

    • The Path Segment Member dialog box appears.
    • A toolbar containing shortcut menus for all the dialog box options appears in the work area.

      Click and drag to reposition the toolbar.

    • The selected sketch is highlighted with the default section profile settings.

    • The selected sketch elements appear in the Path Segment Member dialog box under Segments.
  3. Under Profile, from the Profile Source list, select one of the following.
    • Standards: Uses a Standard section profile for creating members.
    • Custom: Uses a Custom profile for creating members.
      Note: You can create a custom profile using the Structure Section Manager feature. See Creating Custom Sections.
  4. Click to refresh the standard and custom profile sections in the library.
  5. From the Standard list, select a profile.

    The Standard list displays the standard sections that are imported from the standard section library.

    OptionDescription
    DSC Derived from CISC standards
    DSE Derived from European standards
    DSA Derived from AISC standards
  6. From the Type list, select a profile shape to apply to the member.
  7. From the Size list, select a size for the profile shape.

    Alternatively, type in the size field and select the required size.

  8. Under Orientation, specify a rotation Angle for the selected profile.
  9. Optional: From the Pierce Point list, select a position for a member relative to its reference.

    The list displays all the default and custom pierce point options. You can define custom pierce points for standard and custom profiles. See, Creating Structure Sections, Creating Custom Sections.

  10. Optional: Move the Display pierce points slider to enable the preview of pierce points in the work area.

    Alternatively, in the work area, from the shortcut toolbar, click Display pierce points .

  11. Optional: Select Create as a new structure system to add a member to the new structure system and specify the name for the new structure system.

    This option is available after you create the first member.

  12. In the dialog box, click Advanced and do the following:

    1. Specify the start and end offset values for members.

      Alternatively, from the work area, drag the dots.

    2. Click to reverse the direction of the offsets.

  13. Click .

    To specify the offset values for a specific member, select a member in the work area, click the end points of the member, and specify the offset values in the work area or in the dialog box.

 

See Also
Start a Sketch
Editing Members
Updating Standard Sections Library
Using Selection Helper to Create Members
Creating Point-Based Members
Creating Reference Plane Members
Creating Members at the Intersection of Faces and Planes
Creating Members Between Members