Creating Holes

You can create holes.

This task shows you how to:

Before you begin: Create a wall.
See Also
About the Creation of Holes

Create a Hole

You can create a hole.

  1. From the Refine section of the action bar, click Hole .
  2. Select the surface where you want to place the hole.

    A grid appears to help you position the hole.



  3. Click one of the icons to select the hole type.
  4. Select the limit type and define a limit and offset when needed.
  5. Define the following parameters:
    • Main diameter
    • Main depth
    • Bottom type
    • Angle
  6. Define the direction of the hole.

    To reverse the direction, click Reverse .

  7. Click OK.


    Note: You can create the following features:
    • A hole on a hole

    • A hole on a half-height hole

    • A hole on a pocket

    Important: To create a hole on an overlapping element or a bend with a null radius, either choose the top skin of the element, or unfold the 3D shape.

Create a Hole with No Deformation

You can create a hole with no deformation.

Before you begin: Create a wall with a cylindrical bend or a flange.
  1. From the Refine section of the action bar, click Hole .
  2. To position the hole, select the surface.
    Important:
    • The hole point must be associative with the selected surface.
    • The hole direction must be normal to selected surface.
    • The hole should not cut separately more than one face.
  3. Optional: In the Deformation frame, click No Deformation.


Warning: When the No Deformation option is cleared:
  • You can create the hole only on a planar or cylindrical, and single support surface.
  • You cannot create a hole on a double curvature hopper.
  • You cannot create a feature built by thickening on a hole.

Change the Position of a Hole on a Surface

You can change the position of a hole on a surface.

  1. From the Model section of the action bar, click Positioned Sketch .
    The Sketcher app opens and a point representing the hole position appears on the surface.

  2. Move the hole on the surface according to your requirements.


  3. Exit the Sketcher app.

    The hole is changed according to your settings.



Constrain the Location of a Hole

You can constrain location of a hole while creating it.

  1. From the Refine section of the action bar, select two edges on the wall and click Hole .
  2. Click the surface where you want to place the hole.
    Constraints defining the distances between the hole center and the edges are displayed.

    For more information, see Part Design User's Guide: Sketch-Based Features: Holes: Locating Holes.