Creating a Cutout

You can create cutouts of an open or closed sketch.

When you are creating a cutout, you are removing the material from the sheet metal body.

This task shows you how to:

 

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More help on this topic

Create a Standard Cutout

Before you begin: Create a wall that has closed sketch on it.
  1. From the Sheet Metal section of the action bar, click Cutout .
  2. In the Cutout dialog box, click Standard and from the work area, select a sketch as a profile.

  3. For Limit type 1 and Limit type 2 lists, select one of the following:
    OptionDescription
    Dimension Creates the cutout using a depth value.
    Up to next Creates the cutout up to the next surface.
    Up to last Creates the cutout up to the last surface.

    When you drag the handle, you can see the preview. Shaded preview appears on the release of the handle. The area in sheet metal where the cut happens have preview in the yellow color.

    In the above image, the Limit value is Up to Last. By default, the Limit to thickness check box is selected.

  4. Under Cutout direction, select the following options:
    1. Click Direction to specify the cutout direction.
    2. Click Revert cut direction to invert the direction of an extrusion.
    3. Click Revert material side to invert the direction of a material side.
  5. Under Impact Options, from the Face type list, select one of the following:
    • Top to select the top face to begin with the cutout.
    • Bottom to select the bottom face to begin with the cutout.
  6. Click Faces to select specific face with selected face type to that you want to cut out.

    If you do not select any face, by default all the faces are selected for cutout.

  7. Click to save and exit.
    Note: You can use equations for all numeric parameters. Click the dimension text. The dimension text becomes editable. Type = in the input field, to open the Equation dialog box and enter a formula or number..

Create a Pocket Cutout

Before you begin: Create a wall that has closed sketch on it.
  1. From the Sheet Metal section of the action bar, click Cutout .
  2. In the Cutout dialog box, click Pocket and from the work area, select a sketch as a profile.
  3. Specify the values for Limit 1 and Limit 2.
  4. Under Cutout direction, click Revert material side to invert the direction of a material side.
  5. Click to save and exit.

    Pocket cut out with Dimension Limit type.

    Pocket cut out with Dimension Limit type extended up to the top face of the middle wall.

Create a Cutout of an Open Sketch

Before you begin: Create a wall that has an open sketch on it.
  1. From the Sheet Metal section of the action bar, click Cutout .
  2. In the Cutout dialog box, click Standard and from the work area, select a sketch as a profile.
  3. Select Thickness to specify one of the following:
    OptionDescription
    Thickness1 Specifies the outward thickness of a selected open sketch.
    Thickness2 Specifies the inward thickness of a selected open sketch.

  4. Under Cutout direction, select the following options:
    1. Click Direction to specify the cutout direction.
    2. Click Revert cut direction to invert the direction of an extrusion.
    3. Click Revert material side to invert the direction of a material side.
  5. Under Impact Options, from the Face type list, select one of the following:
    • Top to select the top face to begin with the cutout.
    • Bottom to select the bottom face to begin with the cutout.
  6. Click Faces to select specific face with selected face type to that you want to cut out.

    If you do not select any face, by default all the faces are selected for cutout.

  7. Click to save and exit.

Create a Cutout of a Cylinder

You can create a cutout on both the bottom and the top face of a cylinder.

  1. From the Sheet Metal section of the action bar, click Cutout .
  2. In the Cutout dialog box, click Standard and from the work area, select a cylinder as a profile.
  3. From the work area, select the cylinder to pass through the Sheet Metal part.