Creating an Aligned Section View/Cut

You can create an aligned section view or an aligned section cut using a cutting profile. Additionally, you can create an aligned section view or an aligned section cut in a view which already contains a broken profile.

This task shows you how to:

Before you begin:
  • Open a product containing a 3D part and a generated drawing representation.
  • Make sure the front view is active on the drawing (double-click it if needed).
  • Tile your windows vertically to see both your part and the related drawing.
See Also
About Sections
Creating Sections Using Offset Constraints
Creating an Offset Section View/Cut
Creating Sections Using Alternative Methods

Create an Aligned Section View/Cut

You can create an aligned section view or an aligned section cut using a cutting profile as a cutting plane.

  1. From the View Layout section of the action bar, click Aligned Section Cut or Aligned Section View .
    • In the Tools Palette, only the offset constraint is available for selection.
    • In the Creation Options panel, you can select the graphic properties and the operator specifications that you can propagate to this view from its reference view. If the Disable generative view style usage check box is cleared in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Administration tab, then you can also apply the available generative view styles to this view. For more information, see Creating a View using Generative View Styles.
  2. Click in the view to create the first point of the profile.

    In the Tools Palette, you can now select any of the following constraints: Parallel, Perpendicular, Angle, or Offset.

    Important: Parallel, perpendicular and angle are all directional constraints while an offset is a positional constraint. For more information, see About Constraints Available in Tools Palette.

    Note: If you select the offset constraint to define the first segment, the offset constraint is the active constraint. Otherwise, by default, the parallel constraint is the active constraint.
  3. In the Tools Palette, click the appropriate constraint.

    Important: If you select the first constraint other than the offset (parallel, perpendicular or angle), you can select the offset constraint as the second constraint of the profile segment. In this case, the current segment will be constrained two times with parallel/perpendicular/angle constraint along with the offset constraint. When the second constraint (offset) is selected, the Tools Palette will be hidden as long as the second point of the current line is not created.

    However, if you choose the offset constraint as the first constraint, you cannot constrain the current segment using any other constraint.

  4. To set the direction of the profile, select one of the following valid reference element:
    • A generated line, such as an edge, a center line or an axis line. In this case, the constraint will be associative to the referenced 3D geometry.
    • A generated circle. In this case, the constraints will be associative to the 3D.
    • One of the coordinates axis of the sheet. In this case, the constraint will not be associative to the 3D.
    • A sketched line. In this case, the constraint will not be associative to the 3D.
    Tips:
    • The selected constraint is not applied if you select the reference element either as a 2D point (in this case, the profile segment goes through this point), or a 2D circle (in this case, the coincidence constraint is applied and the profile segment goes through the center of this 2D circle).
    • If the second point of the profile is bound by a coincidence constraint, the Offset constraint is disabled.
    • You cannot define two consecutive segments of the same profile with different offset values. Therefore, while defining consecutive profile segments, it is impossible to select either the same reference element, or the lines parallel to that reference element.
    • If you are not satisfied with the profile you created, you can, at any time, use Undo or Redo . Note that Smartpick assists you when creating this profile. For more information, see Sketcher User's Guide: Using Smartpick.
    • Once the profile is created, the constraints associated can be deleted in the edit mode but cannot be modified nor recreated unless you recreate the whole profile.
    • In case the 3D geometry to which the profile is associative is deleted, the profile is still available, but is not associative and the constraint is shown in the edit mode.
    • In case the section view is isolated, all the profile constraints are lost.
    • You can select a cylindrical surface, which is projected as a 2D edge, as the reference element for applying a section constraint. In this case, the constraint is always applied to the axis of the selected cylindrical surface.
  5. The Tools Palette becomes available again for selection of another constraint for the next line.



    The section plane also appears on the 3D part and moves dynamically on the part.



  6. Double-click to end the cutting profile creation.
    Important: Positioning the section view amounts to defining the section cut direction. The cutting profile is associative to the holes.
  7. Click in the sheet to generate the view.



    Notes:
    • You can also create a wavy section edge when the profile of the aligned section cut/view ends inside the geometry. For more information, see Wavy Edges.



    • Wavy edges are not supported in shaded background mode.

Create an Aligned Section View/Cut Containing a Broken View

You can create an aligned section view/cut which already contains a broken profile.

Before you begin: Open a generative drawing representation and create a broken view. Double-click the broken view to activate it.
  1. From the View Layout section of the action bar, click Aligned Section Cut or Aligned Section View .
    • In the Tools Palette, only the offset constraint is available for selection.
    • In the Creation Options panel, you can select the graphic properties and the operator specifications that you can propagate to this view from its reference view. If the Disable generative view style usage check box is cleared in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Administration tab, then you can also apply the available generative view styles to this view. For more information, see Creating a View using Generative View Styles.
  2. Click in the view to create the first point of the profile.
    Note: Consider the following points while creating an aligned section profile:

    • A valid aligned section profile cannot have any end point of a profile segment inside the broken region.
    • A valid aligned section callout profile can be created across the broken region, when the segment crossing the broken region is perpendicular to the two broken lines of that broken operator.

    For more information, see About Sections.

  3. In the Tools Palette, click the appropriate constraint and create the valid aligned section profile.
  4. Double-click to end the section profile creation.
  5. Click in the sheet to generate the view.
    The section view is generated.