Creating Cutouts

You can create cutouts using a sketch or a wireframe element.

Creating cutouts consists in extruding a profile and removing the material resulting from the extrusion.


Before you begin: Create a panel or an extrusion with a sketch and unfold it.

  1. From the Model section of the action bar, click Cutout .
  2. Select the cutout type:
    OptionDescription


    Standard
    Default mode.


    Fold Cutting
    The selected faces are removed and deleted in the folded and unfolded views.
    Notes:
    • Select Keep cycle to take fold angles into account. For more information, see Modifying Fold Angles.
    • Below steps do not apply to the Fold Cutting type.
  3. In the Profile box, select the sketch.

    It can contain one or more shapes, a wire, or a part.

    A preview of the projected cutout appears. The vectors show the side and the direction of the cutout.

  4. Define the direction.
  5. Optional: To choose between removing the material defined inside the profile (default behavior) or surrounding the profile, click Reverse side .
  6. Optional: To invert the direction of the cutout pointed by the arrow, click Invert direction .
  7. To define the end and start limits, select the type and its associated parameters.
    OptionDescription
    Dimension Creates the cutout using a depth value.
    Up to next Creates the cutout up to the next surface.
    Up to last Creates the cutout up to the last surface.
  8. Optional: To consider only the part of the profile that lies on the top or bottom surface, select Lying on skin.
  9. Optional: To thicken the profile, select Thick.
  10. In Impact option, specify the type of faces impacted by the cutout.
    Note: You can select the exact support in the box; for example, to avoid confusions in the case of an overlapping:

  11. To avoid overlapping issues on top or bottom faces, select Optimize Geometry.

    You can specify a gap between the input surface and the cutout result.

    As impacts on both the top and bottom faces are taken into account, the result of the cutout is improved.