Axial Machinable Features

Formulas, Checks and Tool Queries

Axial Machinable Features is used for formulas, checks, and tool queries in machining processes and machining operations.

Examples: Nominal diameter>=Machinable Axial Feature.Diameter*0.85 or Nominal diameter<=Machinable Axial Feature.Diameter*0.95

See Using Knowledge in Machining Processes

Search Queries

Axial Machinable Features is used in search queries.

Associativity of Machinable Axial Features

Machinable Axial Features are associative after a design change (modification, move or delete) of the shape referenced by the feature.

This is best illustrated by the two following scenarios.

• Case 1: Modifying or Moving Faces

  Possible design changes by modifying or moving faces are:

  • Modify the shape of faces referenced by a Machinable Axial Feature (iso-topology)
  • Move the shape of faces referenced by a Machinable Axial Feature (iso-topology)
  • Move the products where faces of a Machinable Axial Feature are referenced.

    The expected result is as follows:

    • When editing the Machinable Axial Feature all the parameters are updated according to the new specifications.
    • When updating the status of any Drilling operation referencing a Machinable Axial Feature, an Update status is displayed on the operation in the Activities tree.
    • When editing any Drilling operation referencing a Machinable Axial Feature, Feature parameters displayed in Geometry tab are updated according to the new specifications
    • When replaying any Drilling operation referencing a Machinable Axial Feature, Tool Path replay shows the tool path at the appropriate location (except if locked).

• Case 2: Removing Faces of a Shape

  The design change is made by removing faces of a shape referenced by a Machinable Axial Feature from the Design Part.

  When updating the status of any Drilling operation referencing a Machinable Axial Feature, a Geometry Not Found status is displayed on the operation in the Activities tree.

  Note: Replay is not available in this case.

Simple Hole

The holes is Threaded Holes

• 
  
  
• 
  
  

A simple hole is characterized by:

• origin point and direction
• hole depth and diameter
• extension type identified according to the evaluation of the Hole Extension attribute:
  • 1 = blind
  • 2 = through
• for blind holes, bottom type identified according to the evaluation of the Hole bottom type attribute:
  • Flat Bottom
  • V Bottom
• for V-bottom holes, bottom angle identified according to the value of the Hole bottom angle attribute.

Tapered Hole

• 
  
  
• 
  
  

A tapered hole is characterized by:

• origin point and direction
• hole depth, diameter and angle
• extension type identified according to the evaluation of the Hole Extension attribute:
  • 1 = blind
  • 2 = through
• for blind holes, bottom type identified according to the evaluation of the Hole bottom type attribute:
  • Flat Bottom
  • V Bottom
• for V-bottom holes, bottom angle identified according to the value of the Hole bottom angle attribute.

Counterbored Hole

The holes is Threaded Holes

• 
  
  
• 
  
  

A counterbored hole is characterized by:

• origin point and direction
• hole depth and diameter
• counterbored depth and diameter
• extension type identified according to the evaluation of the Hole Extension attribute:
  • 1 = blind
  • 2 = through
• for blind holes, bottom type identified according to the evaluation of the Hole bottom type attribute:
  • Flat Bottom
  • V Bottom
• for V-bottom holes, bottom angle identified according to the value of the Hole bottom angle attribute.

Counterdrilled Hole

The holes is Threaded Holes:

• 
  
  
• 
  
  

A counterdrilled hole is characterized by:

• origin point and direction
• hole depth and diameter
• countersunk angle
• counterbored depth and diameter
• extension type identified according to the evaluation of the Hole Extension attribute:
  • 1 = blind
  • 2 = through
• for blind holes, bottom type identified according to the evaluation of the Hole bottom type attribute:
  • Flat Bottom
  • V Bottom
• for V-bottom holes, bottom angle identified according to the value of the Hole bottom angle attribute.

Countersunk Hole

The holes is Threaded Holes:

• 
  
  
• 
  
  

A countersunk hole is characterized by:

• origin point and direction
• hole depth and diameter
• countersunk angle and diameter
• countersunk depth
• extension type identified according to the evaluation of the Hole Extension attribute:
  • 1 = blind
  • 2 = through
• for blind holes, bottom type identified according to the evaluation of the Hole bottom type attribute:
  • Flat Bottom
  • V Bottom
• for V-bottom holes, bottom angle identified according to the value of the Hole bottom angle attribute.

Threaded Holes

The following attributes on the axial machinable feature allow you to access threaded hole information (in the Search function, machining process definition, machining operations that require thread information, and so on).

• Threaded: True or False
• Thread diameter (length value)
• Thread depth (length value)
• Pitch (length value)
• Thread direction: 0 = Right-threaded 1 = Left-threaded

The attribute values are read from the design threaded hole (i.e., as specification).

Co-axial Hole Merge Capabilities

Co-axial holes is merged automatically with the Global Feature Recognition command. Additional merge possibilities are available using the Manufacturing View.

The following check boxes in the Global Feature Recognition dialog box provide a number of new capabilities for automatically merging co-axial holes such as Automatic Merge of Co-Axial Holes, Merge Co-Axial Holes and Holes with same diameter, One blind hole needed

These capabilities are illustrated by considering the following three cases:

• Case 1: In the figure below, both the holes are through holes. In previous versions, these holes could not be merged automatically due to absence of a blind hole.
  
  
• Case 2: In the figure below, hole 1 is a through hole and the other two co-axial holes are blind. In previous versions, automatic merge of hole 1 and hole 2 was not possible due to the presence of the two co-axial blind holes.
  
  
• Case 3: In the figure below, hole 1 and hole 2 have the same diameter (40 mm), hole 3 and hole 4 have same diameter (30 mm), and hole 5 and hole 6 have the same diameter (20 mm). In previous versions, holes with different holes could not be merged.
  
  

The table below shows which these cases is processed using the different combinations of the check boxes in the Global Feature Recognition dialog box.

Check box selection	Case 1	Case 2	Case 3
Merge Co-axial Holes and One blind hole needed and Holes with same diameter	No	Yes	No
Merge Co-axial Holes and One blind hole needed	No	Yes	Yes
Merge Co-axial Holes and Holes with same diameter	Yes	Yes	No
Merge Co-axial Holes only	Yes	Yes	Yes

Geometry Considerations for Pattern Creation

Pattern creation operates on a set of axial features selected from the Manufacturing View, a set of faces, or an entire body.

• For a set of axial features, pattern creation applies the matching criteria only to that set of features.
• For a set of planar faces, pattern creation applies the matching criteria to all axial features from each face in the set. Note that all features in a pattern have identical axes. If a reference direction is defined, the matching criteria only applies to axial machinable features parallel to this axis.
• For a set of non-planar faces, pattern creation applies the matching criteria to all axial features from each face in the set. Features in the pattern can have different axes. If a reference direction is defined, automatic pattern creation only applies to axial machinable features parallel to this axis.
• For a body, pattern creation applies the matching criteria to all axial features. Note that all features in a pattern have identical axes. If a reference direction is defined, automatic pattern creation only applies to axial machinable features parallel to this axis.

Using Tolerances in Pattern Creation

You can retrieve the fitting tolerances defined in design features when Machinable Axial Features are created and match these tolerance values in the pattern creation functionality:

• The Tolerance Value check box lets you match the fitting tolerance for pattern creation.
• You can create patterns of holes having same tolerance values. Matching is done for both tabulated (H7, and so on) as well as minimum/maximum tolerance values.
• Features having the same tolerance values are grouped in the same pattern. Other holes, for which the tolerance value is not defined, form a separate pattern.
• The fitting tolerance value is displayed in the dialog box of the Machinable axial feature and in the Manufacturing View on a created pattern.

Pattern Creation with Color Criteria

When you select the Color check box for pattern creation, colors of holes are matched for creating patterns. The color of the axial machining feature faces is taken into account for pattern creation.

This color may be a basic color or a RGB color (Red, Green, Blue value).

All holes have a color. When no specific color is defined on the faces, the face color is the same than the body color.

• If only the Color check box is selected then all the holes with same machining axis and having same color form a pattern. This behavior is similar to other pattern creation options. For all the pattern creation options a created pattern have holes with same machining axes. Exception to this is holes having non-planar top faces. When there are some holes having non-planar top faces and if none of the holes have the axis same as any of the planar holes, then these holes can form a single pattern even if their axes do not match.
• If other criteria are also selected along with color then holes matching all the other criteria and color form one pattern.
• If only color is selected and machining direction is specified, then all the holes having axis parallel to machining direction and having same color form one pattern. Holes, which do not have axis parallel to machining direction, does not form any pattern.
• If the holes have more than one color, these holes come under a separate pattern for that specific orientation.

Example of Part with counterbored holes (same hole and counterbored diameters):

• Ten counterbored without specific color
• Ten counterbored (all faces in red)
• Ten counterbored (first diameter face in blue, second diameter face in red, other faces without specific color).

Example of Hole with more than one color is taken into account in a specific pattern. Three patterns are created:

• pattern for the undefined color (10 holes)
• pattern for the red color (10 holes)
• pattern for the holes with more than 1 color (10 holes)

Creating Machining Patterns Automatically

You can create machining patterns automatically during global feature recognition in the Machinable Axial Features.

Additionally Machining Pattern is created by using command Machining Pattern in Machining Features action bar.

Initially the permanent representations of Machining Patterns are "Hidden". Make them visible by selecting Show option in the context menu of the Pattern in manufacturing view. You can also make all the patterns visible by selecting all patterns and select Show on Right-clicking. You can also hide permanent representation of Machining Pattern through selection of Hide/Show menu item in context menu on Right-click the pattern in the 3D viewer.

Following Representation elements is used for permanent representations of a Machining Pattern.

• Entry point (hole origin)
• Entry vector (hole direction)
• Text Showing Position
• Connecting vector between positions

The Green color is used for the permanent representations of a Machining Pattern.

Permanent representations of Machining Patterns in the 3d viewer is selected by clicking on the existing command NO point in the geometry panel of manufacturing axial operations.