Filtering and Merging a Product

You can filter a product into a product containing one representation. Product Filtering & Merging proposes several options related to the creation of the final product or the elements to transfer to the final product. By default, only Create: A product with a shareable representation option is selected.

Notes:

  1. To filter and merge a product like this one:

    1. From the IP Protection section of the action bar, click Product Filtering & Merging .
    2. Select the product node.

    This product can be:

    • A product with a non-shareable representation
    • A product with a shareable representation
    • A 3D Part.

  2. Enter an identification string on the right of the product name.
  3. Click the arrow to expand the dialog box.
  4. Define the creation mode of the final product.
    • With Create: A 3D Part, the input product is filtered and merged into one 3D Part, that is a product with an aggregated representation.

    • With Create: A product with a shareable representation, the input product is filtered and merged into one product containing one shareable representation.

    • With Create: A product with non shareable representation, the input product is filtered and merged into one product containing one non-shareable representation.

  5. Optional: Select the Merge body check box.
    • For solids:
      • The solids found in all the bodies of each representation of the original product are merged in one body (Boolean operations).
    • For surfacic elements:
      • The ordered geometrical sets are merged in one hybrid body, if you have enabled hybrid design.
      • The geometrical sets are merged in one body, if you have not enabled hybrid design.
    Note: 3D Tolerancing & Annotation data are not kept when this option is selected.
  6. Optional: Under Keep, select the Colors check box, then the required option.

    Note: Graphic attributes other than color and transparency (line type, thickness, symbol, ...) are copied with their default value regardless of the status of this option.

    • Overloaded faces: This option overrides the standard behavior for colors, transparency and applicative attributes, and keeps the visual aspect of the original data. For example, if the color of one face has been changed like this

      the result of the transfer looks the same.
      Notes:
      • Be aware that this option may be time consuming.
      • If a body is not up-to-date (update mask displayed in the tree), the color of the subelements will not be kept, even if this option is selected.
      • When the color or the opacity of a subelement has been overloaded (at the level of the subelement or at the level of one of its parents), in the result part, the overloaded color or opacity is kept on the subelement, but can be changed at the level of the subelement only, not at that of its parents. If you overload the color or opacity of one of its parents, the color or opacity of the subelement will not change.
    • Container: The whole transferred solid takes the color and transparency of the original body.

    • When Colors is not selected, the result takes the default color and transparency.

  7. Optional: Select the Keep annotations check box to transfer 3D Tolerancing & Annotation data (FTA) and 3D Tags from Generative Shape Design found in the shape representation of the product to filter.
    1. Optional: Select the Contains the string check box to restrict the filtering process to 3D Tolerancing & Annotation captures with a name containing a string you provide.
      • If you leave the string empty or undefined, all the 3D Tolerancing & Annotation features are transferred.
      • The names of the Geometrical Links features of the transferred 3D Tolerancing & Annotation features (that are displayed in the Connection Management dialog box) are partially kept:
        • The names of Group Of Surfaces and User Surface features are kept.
        • The names of Geometric Component features are not kept, and are replaced by a default name in the result product.
      • In addition, the transferred 3D Tolerancing & Annotation features are displayed in the tree with the same names as in the original product and in the exact same order.
      • You will be asked to propagate the original product after having filtered is using the Keep annotations. Do not propagate the product, unless you have made modifications.

      See About the Filtering of 3D Tolerancing & Annotation for more information.

  8. Optional: Select the Material check box to transfer the material information.

    Material applied to faces is not taken into account.

    • If Merge body is not selected, only material applied at the body level is taken into consideration and kept. If in the origin product material was applied to a 3D Part or 3D Shape, but not to bodies, the material is not kept.
    • If Merge body is selected, material is kept only if merged bodies have the same material.
  9. Optional: Under For sketch, select the Specifications of sketches check box.
    • When this option is not selected, the sketch is transferred As Result. The resulting sketch is not editable.
    • When this option is selected, the sketch is transferred As specified in Part document:
      • The resulting sketch is editable.
      • The sketch support positioning is switched to isolated definition mode.
      • The sketch parameterization and all its associativity with external features is removed:
        • Constraints and their formulas
        • Output and output profile features
        • All construction geometries
        • All geometries in NoShow.
      • Use-edges (projections, intersection, ...) are isolated and converted to sketched curves.
      • In the case of used-edges with a complex curve mark, the wire isolation cannot keep the sub-element naming, nor the previous orientation of the curves.
  10. Optional: Select a Visualization Filtering option.

    • Visible Features Only
    • Visible Geometry Only
      • If a feature or a geometry is at least partially visible from a number view points controlled by accuracy values, the feature or the geometry is kept in the result product.
      • If a feature or a geometry is completely hidden, it is removed from the result product.
      Note: This option detects small faces, and may be time consuming.
    • Accuracy (Low, Medium, High, Very High) controls the number of view points to consider an element as visible or not. Low provides fewer view points, Very High much more. Medium is the default value.