Creating a Boss

You can add material only to the outside of a material volume.

Note: Depending on your role, you may not have access to this functionality.

Before you begin: Open a 3D shape representation.
See Also
Creating Functional Features
Using the Display Only Parents Option to Retrieve a Creation Context
About Bosses
  1. From the Create section of the action bar, click Boss or Pull .
  2. In the Boss.X dialog box, select a closed profile.

    Tip: If no profile is defined, click Positioned Sketch to sketch the profile.

  3. In the Length boxes under Ceiling and Opening tabs, enter the required values.

    The ceiling length defines the distance from the sketch plane up to the ceiling and the opening length defines the distance from the sketch plane up to the opening.



  4. Click Mirrored extent to extrude the profile in the opposite direction using the same length value as the one defined for the first length.


  5. To define the direction of the boss, select the required reference element in the Direction box.

    By default, the boss is created in the direction normal to the profile.

    Tip: Click Reverse Direction to reverse the extrusion direction. You can also select the arrow in the work area to reverse the direction.

  6. In the Draft tab, specify the following draft parameters as required.
    1. From the Draft behavior list, select Intrinsic to feature to define the draft behavior.
    2. In the Angle box, specify the draft angle.

      You can select the Draft both sides check box to create draft both the sides when you select the Parting = Neutral check box.

      The default neutral element is the profile plane. It defines a neutral curve on which the drafted face lies. The other possible neutral elements are:

      • Ceiling
      • Opening
      • Plane/Surface

    3. To define the parting element as a neutral element, select the Parting = Neutral check box.
    4. To apply fillets before creating a draft, select the Draft fillets check box.

      The small edges that do not lie on the parting surface might be created. With this option, the fillets will become the variable radius fillets instead of the constant fillets and it prevents from generating the extra edges.

      Note: The status of the Draft fillets check box (selected or cleared) appears in the Fillet tab.

  7. In the Fillet tab, specify the following fillet parameters as required.
    1. Select among the following check boxes and enter the required values, to fillet the corresponding edges:

      • Lateral radius to fillet lateral edges.
      • Ceiling radius to fillet the edges of the cylinder's top.
      • Draft fillets to apply fillets before creating a draft.



    2. From the Intersection fillet list, select one of the following options to create fillets at the required intersections:

      • Intersection with Core/Cavity
      • Intersection with Core
      • Intersection with Cavity

    3. To create fillets by adding material to the feature, select the Fillet radius check box.
    4. To create fillet by removing material from the feature, select the Round radius check box.
    5. To maintain the thickness at fillets, select the Preserve Shell Thickness check box.
  8. Under Wall, select the direction for the construction of the wall (inside or outside).

    You can select among following check boxes to define the wall thickness:

    • Use body thickness: Uses the thickness of the active shelled body thickness. By default, this option is selected.
    • Enter thickness: Uses the defined thickness value.

    You can select the Constant Thickness check box to apply lateral fillets to the feature with a constant wall thickness.

  9. Click OK.

    The boss is created. The Boss.X node is added to the tree under Solid Functional Set.x.

    Outside

    Inside