Creating a Protected Feature

You can create a basic feature that creates areas within the same body, and additional material cannot penetrate the protected areas. This is useful if you need to reserve space to add another features or for areas that must be kept open.

See Also
Creating a Protected Feature
  1. From the Create section of the action bar, click Protected Feature .

    A feature can have one of the following shape definitions: Prism , Sweep , Revolve , Thick Surface , or External Shape . For more Information, see Working with Shape Definitions.

    Prism is selected as the default shape definition.
    Note: You can change the shape definition. The dialog box for the feature changes according to the options offered by the shape.
  2. Select the profile you want to extrude.
  3. In the Reference list, select Neutral Fiber to add material equally to both sides of the profile.
  4. Click Preview.
    The thickness defined as Inside Thickness is evenly distributed to each side of the profile.



  5. Optional: In the Draft tab,
    1. From the Draft behavior list, select Intrinsic to feature.
    2. Set profile plane as the neutral element and enter the required value to define the draft angle.
  6. Optional: In the Fillet tab,
    1. Select among the following check boxes and enter the required values, to fillet the corresponding edges:

      • Lateral radius to fillet lateral edges
      • First radius to fillet top edges
      • Second radius to fillet bottom edges

    2. Select the Fillet profile ends check box, to fillet the end faces of open sketches.
    3. Select the Draft fillets check box, to fillet the drafted edges.
    4. From the Type list under Intersection Fillet, select among the following, to create fillets at required intersections:

      • Intersection with Core/Cavity
      • Intersection with Core
      • Intersection with Cavity

    5. Select the Fillet radius check box to create fillet by adding material to the feature.
    6. Select the Round radius check box to create fillet by removing material from the feature.
    7. Select the Preserve shell thickness check box to maintain the thickness at fillets.
  7. Click OK.
    The protected feature is created. As a protected area, the protected feature is displayed in red. Protected Prism.x is added to the tree in the Solid Functional Set.x node.