Creating an Offset Section View/Cut

You can create an offset section view or an offset section cut using a cutting profile. In addition, you can create an offset section view or an offset section cut in a view, which already contains a broken profile.

This task shows you how to:

Before you begin:
  • Open a product containing a 3D part and a generated drawing representation.
  • Double-click to activate the front view in the drawing.
  • Tile your windows vertically to see both your part and the related drawing.
See Also
About Sections
Creating Sections Using Offset Constraints
Creating an Aligned Section View/Cut
Creating Sections Using Alternative Methods

Create an Offset Section View/Cut

You can create an offset section view or an offset section cut using a cutting profile as cutting plane.

  1. From the View Layout section of the action bar, click Offset Section View or Offset Section Cut .
    • In the Tools Palette, only the offset constraint is available for selection.
    • In the Creation Options panel, you can select the graphic properties and the operator specifications that you can propagate to this view from its reference view. If the Disable generative view style usage check box is cleared in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Administration tab, then you can also apply the available generative view styles to this view. For more information, see Creating a View using Generative View Styles.
  2. Click in the view to create the first point of the profile.

    In the Tools Palette, you can now select any of the following constraints: Parallel, Perpendicular, Angle, or Offset.

    Important: Parallel, perpendicular, and angle are all directional constraints while an offset is a positional constraint. For more information, see About Constraints Available in Tools Palette.

  3. In the Tools Palette, click the appropriate constraint.

    Important: If you select the first constraint other than the offset (parallel, perpendicular or angle), you can select the offset constraint as the second constraint of the profile segment. In this case, the current segment will be constrained two times with parallel/perpendicular/angle constraint along with the offset constraint. When the second constraint (offset) is selected, the Tools Palette will be hidden as long as the second point of the current line is not created.

    However, if you choose the offset constraint as the first constraint, you cannot constrain the current segment using any other constraint.

  4. To specify the direction of the profile, select one of the following valid reference elements:
    • A generated, such as an edge, a centerline, or an axis line. In this case, the constraint is associative to the referenced 3D geometry.
    • A generated circle. In this case, the constraints are associative to the 3D.
    • One of the coordinates axis of the sheet. In this case, the constraint is not associative to the 3D.
    • A sketched line. In this case, the constraint is not associative to the 3D.
    Tips:
    • Selecting a constraint keeps the Tools Palette hidden, until the second point of the current line is not created.
    • The selected constraint is not applied if you select the reference element either as a 2D point (in this case, the profile segment goes through this point), or a 2D circle (in this case, the coincidence constraint is applied and the profile segment goes through the center of this 2D circle).
    • If you are not satisfied with the profile you created, you can, at any time, use Undo or Redo . Note that Smartpick assists you when creating this profile. For more information, see Sketcher User's Guide: Using Smartpick.
    • Once the profile is created, the constraints associated can be deleted in the edit mode but cannot be modified nor recreated unless you recreate the whole profile.
    • In case the 3D geometry to which the profile is associative is deleted, the profile is still available, but is not associative and the constraint is shown in the edit mode.
    • In case the section view is isolated, all the profile constraints are lost.
    • You can select a cylindrical surface, which is projected as a 2D edge, as the reference element for applying a section constraint. In this case, the constraint is always applied to the axis of the selected cylindrical surface.

    The section plane appears on the 3D part and moves dynamically on the part.

  5. Double-click in the sheet to end the cutting profile creation.

    When creating an offset section view, remember that positioning the section view using the cursor defines the section view direction. The cutting profile is associative to the hole.





    Click in the sheet to define the section cut direction and position the view.



  6. Double-click the profile to modify the section profile. On the context toolbar, select one of the following:

    • Replace Profile
    • Reverse View Direction
    • Manipulation in one direction according to the callout or Manipulation in two directions according to the callout

  7. Select Replace Profile and sketch a new profile.
  8. Click in the sheet to define the section cut direction and position the view.



  9. Right-click the callout and select Properties. Under the Callout tab, modify the required callout properties.



    Notes:
    • The frame of the active view adapts to the length of the cutting profile.
    • You can assign a line type to the view to be generated. For this, go to Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > View section, click Configure next to View Linetype and select the required options from the dialog box.
    • There is no associativity for .model files.
    • You can also create a wavy section edge when the profile of the offset section cut/view ends inside the geometry. For more information, see Wavy Edges.



    • Wavy edges are not supported in shaded background mode.

Create an Offset Section View/Cut Containing a Broken View

You can create an offset section view/cut, which already contains a broken profile.

Before you begin: Open a generative drawing representation and create a broken view. Double-click this view to activate it.
  1. From the View Layout section of the action bar, click Offset Section View or Offset Section Cut .
    • In the Tools Palette, only the offset constraint is available for selection.
    • In the Creation Options panel, you can select the graphic properties and the operator specifications that you can propagate to this view from its reference view. If the Disable generative view style usage check box is cleared in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Administration tab, then you can also apply the available generative view styles to this view. For more information, see Creating a View using Generative View Styles.
  2. Click in the view to create the first point of the profile.
    Note: Consider the following points while creating an offset section profile:

    • A valid offset section callout profile cannot have a start point of the first segment or end point of the last segment of a callout profile inside a broken region zone.
    • An offset section callout profile can only have even-numbered profile segments fully defined inside a broken region zone. (Profile segment number starting with 1).
    • A valid offset section callout profile can be created across the broken region zones when the segment crossing or intersecting the broken region zone follows the perpendicularity rule with respect to the broken operator lines.

    For more information, see About Sections.

  3. In the Tools Palette, click the appropriate constraint and create the valid offset section profile.
  4. Double-click to end the section profile creation.
  5. Click in the sheet to generate the view.
    The section view is generated.