Creating User-Stamps

You can create user-stamps from a punch feature, or from punch and die features.

This task shows you how to:

See Also
About Creating User-Defined Stamps

Create Punches with Opening Faces

You can create a stamps from a punch feature with opening faces.

The punch with opening faces can be defined in a Sheet Metal 3D shape or in another part. In this case, when selecting the punch feature, the system automatically copies it into3D shape into which the base feature to be stamped is located. A link is retained between the initial punch feature and its copy.

Before you begin: Create a pad and an edge fillet in Part Design.
  1. From the Refine section of the action bar, click User Stamp .
  2. Select a base feature.

    It is used to define the location and direction of the stamping, by matching the punch's origin to the selected point on the base feature.

  3. Click With opening .
  4. Select the punch.
    The punch is previewed on the base feature.

    Important:
    • The punch height cannot be superior to the base feature height, otherwise it is considered as a cutout.
    • You can click Open catalog to insert a punch from a catalog. For further information, see Browsing the Sheetmetal Catalog.
  5. From the Radius box, define a radius value.
  6. From the Stamp position box, select the origin point.
  7. Optional: To change the direction of the stamp, click Reverse direction .
  8. Click Preview.
    The stamp is previewed with the opening faces:

  9. Click OK.
    The punch is automatically set to the No Show mode.

    Warning: Avoid using stamps with faces merging with the face of the base feature, as it would be difficult to remove afterwards, especially on a curved part. If you do use such a stamp, select the stamp face tangent to the base feature and define it as an open face.

Create Punches with Dies

You can create stamps from punch and die features.

This user-defined stamping cannot be combined with the opening and cutting faces.

Before you begin: Create a shaft in Part Design.
  1. From the Model section of the action bar, click User Stamp .
  2. Select a base feature or a face.

    It is used to define the location and direction of the stamping, by matching the punch's origin to the selected point on the base feature.

  3. Click With die .
  4. Select the punch.
    The punch is previewed on the base feature or face.

    Important:
    • The punch height cannot be superior to the base feature height, otherwise it is considered as a cutout.

    • You can click Open catalog to insert a punch from a catalog. For more information, see Browsing the Sheetmetal Catalog.
  5. Select the die.
    The die is previewed on the base feature or face.

  6. From the Radius box, define a radius value.
  7. From the Stamp position box, select the origin point.
  8. Optional: To change the direction of the stamp, click Reverse direction .
  9. Click OK.
    By default, the punch and die features are automatically set to the No Show mode.

    Important:
    • As the punch and die are not symmetrical, you cannot create features such as cutouts, holes, or corners.
    • Only the stamping sketch is displayed in unfolded views.