Creating a User Weld

Using User Weld and by selecting a shape, you can create a weld that fully meets your needs. For example, you can create a U-shaped weld, or user welds from faces that are not in contact. You can then generate the user welding symbol on a drawing.

To design your own weld, the faces you need to join are not necessarily in contact.

Before you begin:
  • Create an empty body in the weld representation.
  • Create a bundle of welds.
  • Create a seam, for example a pad, and optionally a preparation.
  1. From the Weld section of the action bar, click User Weld .
  2. Select a weld body or a bundle of welds in the tree.
  3. Select the faces as supports.


    Important: You can create user welds from faces that are not in contact.

    Note: To control the faces you need:
    • To add or remove faces defining the supports (as displayed in the Supports list), press Ctrl + Click.
    • You can add to or remove faces from a support using the Edit selection context menu from the Supports list.
      • Clicking a face in the work area adds it to the list.
      • To remove a face from the list, use Remove selection.
  4. Click Weld Seam and select the shape defining the seam. In our example, the shape is a triangle.
  5. Optional: Select the preparation you want to use.
    Note: The shape of the preparation can be longer than the weld.
  6. Optional: To trim the weld to a surface or another weld, select the limits.
  7. Click Preview to show the user weld wireframe.


  8. Optional: Specify a weld symbol, a weld size and a weld length in Drafting Parameters. This information can be retrieved when extracting weld annotations for a drawing.
  9. Optional: To define the shape of the weld, click the Manufacturing tab and select an option. The shape defines the weld seam shape representation in drafting context. If you select Convex or Concave , specify a curvature value in Offset. The offset is the maximum distance between the weld face and arc.

    For more information about manufacturing options, see Manufacturing.

    Note: Shapes are extracted on drawings.

  10. Optional: To define the shape of the weld, click the Manufacturing tab and select an option. If you select Convex or Concave , enter a curvature value in Offset. The offset is the maximum distance between the weld face and the arc.
    Notes:
    • The shape is retrieved on drawings.
    • If you generate a V-butt or a bevel-butt weld and select Broad Root Face, the welding symbols extracted on a drawing are and .

    For more information about manufacturing options, see Manufacturing.

  11. Optional: Select Generate Weld Impacts.
    The app performs a Boolean subtract of the weld shape from the plates being welded.
  12. Click OK.
    The user weld is created but affected representations are not prepared for the welding.
  13. Click Update .
    The affected representations are now prepared for the welding.

    The user weld appears in the tree.
    • Its supports and their external references appear under the user weld.
    • External references appear under the External References node too.
    • The weld preparation appears as Assembly features .
    • The body containing information about the weld seam and the weld preparation appear in No Show status.
    • An assembly protected weld preparation is created and appears under the Assembly features node.
    • The welded 3D shapes are prepared.
      Important: In the tree, the weld impact appears as a feature in the PartBody including impacted 3D shapes. A rep impact is created, maintaining a link between the root product under which the bundle of weld, weld body, and welds are created. Rep impact appears under Impacts manager .