Creating a Clipping View/Clipping View Profile

This task shows you how to create from the 3D a clipping view using a circle as callout, or a clipping view profile using a sketched profile as callout. The procedure varies slightly depending on the method you choose.

Before you begin:

  • Open a generative drawing representation containing a section view.

  • Go to Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > View section and select Put in no show dimension on non-visible geometry check box to specify that the dimensions that are attached to non-visible geometry in clipping views must be put in no show mode automatically.

    Note: This option is applicable only to Exact views.

See Also
About Clippings
Modifying a Clipping
  1. Double-click the section view.
  2. From the View Layout section of the action bar, click Clipping View Profile to create a clipping view using a sketched profile as callout.

    To create a clipping view using a circle as a callout, click Clipping View .

  3. Select the required points for sketching a polygon. If you are creating a clipping view using a circle, select the center of the circle.



  4. Close the polygon, or double-click to end its creation.

    If you are creating a clipping view using a circle, Move the pointer to define the clipping profile, then click to validate. The view and the associated profile result are as shown below:



    Note: The existence of dimensions that are associated with a geometrical element that is not visible in the clipping view: these dimensions are placed in the no-show space. (When applicable, this is also the case of annotations that are associated with such a dimension, and of annotations that are no longer linked to the clipping view.) For more information, refer to View.

  5. From the View section of the action bar, click Swap visible space .

    You can now visualize the dimensions (and annotations, when applicable) that no longer appear on the clipping view.

    Important: Dimensions are displayed in clipping views using the colors defined in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Display section, under Activate elements' analysis. For more information, see Display.
  6. Optional: You can show these dimensions again on the clipping view. To do so, click Hide/Show , from the View section of the action bar.
    Important: You can also right-click the view and select View Definition > Unclip. However, selecting this option will not show the dimensions on the unclipped view.
  7. Select the dimension you want to show on the clipping view.
  8. Click Swap visible space again.
    The selected dimension now appears on the clipping view again.



Note: While creating a clipping view profile, an S break symbol is created at the limit edges of the cylindrical elements only. For this, the GVS parameters must be defined. For more information, see Break.