Creating a Detail View or a Detail View Profile

You can create a detail view from the 3D using either a circular profile or a sketched profile as callout.

Before you begin: Open a 3D part representation containing a drawing.
See Also
About Detail Views
Creating a Quick Detail View or a Quick Detail View Profile
  1. Perform either of the following operations in the View Layout section of the action bar:
    • To create a circular detail view, click Detail View .
    • To create a detail view using a sketched profile, click Detail View Profile .
    In the Creation Options panel, you can select the graphic properties and the operator specifications that you can propagate to this view from its reference view. If the Disable generative view style usage check box is cleared in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Administration tab, then you can also apply the available generative view styles to this view. For more information, see Creating a View using Generative View Styles.

    In this scenario, lets create a circular detail view.

  2. Click to position the callout center.

    If you are creating a detail view using a sketched profile, create the required points for sketching a polygon.

  3. Move the pointer to increase the callout radius and click to validate.

    If you are creating a detail view using a sketched profile, double-click to end the cutting profile creation. Note that if you do not close the profile, it is closed automatically.



  4. Optional: Select the 2D generative edge in this view to create an associative detail profile.
    A message appears at the upper-right corner of the screen informing that the detail view is now associated with the selected generative item. For more information, see About Detail Views.
  5. Click in the sheet to generate the detail view.

    The associative detail view is created and the message disappears automatically once you indicate the location of the resultant detail view by clicking at the appropriate location in the sheet.

    Note: The default value of scale is 2 (twice the scale of the active view). You can modify this scale from the Properties dialog box.

  6. To modify the scale, right-click the detail view and select Properties.
  7. Under the View tab, in the Scale box, enter a scale, for example 3:1.
  8. Click OK to validate.



    Important:
    • You can also modify the sketched detail profile through the Properties dialog box.
    • In the isometric view, you can move the detail text ("A" in this example) after detail view creation.

Note: While creating a detail view profile, an S break symbol is created at the limit edges of the cylindrical elements only. For this, the GVS parameters must be defined. For more information, see Detail.