Creating a Sequential Turning Operation

You can create a Sequential Turning operation in the Manufacturing Program.

  1. From the Turning Machining section of the action bar, click Sequential Turning .
    A sequential turning item is added to the manufacturing program.
  2. In the Sequential Turning Operation dialog box that appears, create the following motions in the Strategy tab:
    1. Select Go and define the first motion parameters.

      The first motion must be a Go motion.

    2. In the dialog box that appears, click one of the red lines and select a check element in the work area.
    3. Click OK to define the motion.
    1. Select Go again and define the second motion parameters.
    2. In the dialog box that appears, click one of the red lines and select a check element in the work area.
    3. Right-click First check mode and Second check mode and select To.
    4. Set the Offset on check value of the First check element to 2mm.
    5. Click OK to define the motion.
    1. Optional: Select Go again and define the motion parameters.
    2. In the dialog box that appears, click one of the red lines and select a check element in the work area.
    3. Right-click First check mode and Second check mode and select Past.
    4. Set the Offset on check value of the Second check mode to 5mm
    5. Click OK to define the motion.
    1. Select Go InDirv .
    2. Select the drive direction (red line) and select a linear element in the work area.
    3. Select a check geometry in the Geometry tab then select the desired check element in the work area.
    4. Set the Check Mode to To and the Offset on check: 5mm.
    5. Click OK to define the motion.
    1. Select Follow .
      The check curve of the previous motion is used as drive curve. This drive element is highlighted in the work area.
    2. Select a check geometry in the Geometry tab and then select the desired check element in the work area.
    3. Set the Check Mode to To.
    4. Click OK to define the motion.
    1. Select GoTo Point .
    2. Select a check geometry in the Geometry tab and select the desired check element in the work area.
    3. Specify values in the Axial offset and Radial offset text boxes.
    4. Click OK to define the motion.

    You can define the tool axis for each motion using the icon that appears in the viewer.

  3. Go to the Tool tab to select a tool.

    See Assigning a Tool Element to a Machining Operation

  4. Select the Feeds and Speeds tab to specify the feedrates and spindle speeds for the Machining Operation.
  5. Select the Macros tab to specify the operation's transition paths.
    For more information, see Defining Macros on Turning Operations.
  6. Click Simulate or Display to check the validity of the Machining Operation.

    See Simulating the Tool Path.

    • The tool path is computed.
    • A progress indicator is displayed.
    • You can cancel the tool path computation at any moment before 100% completion.


  7. Click OK to create the Machining Operation.

    Sequential Turning