Creating and Editing Machinable Axial Features

You can create machinable axial features based on the selected filter criteria like diameter values, depth values, etc. and then assign them to operations in sequence. You can also modify the filter criteria and create the next set of machinable axial features and assign these newly created axial features to operations.

This task shows you how to:

Create Machinable Axial Features

You can create machinable axial features based on the selected filter criteria like diameter values, depth values, etc. and then assign them to operations in sequence. You can also modify the filter criteria and create the next set of axial features and assign these newly created axial features to operations.

  1. From the Axial Machining section, select Global Feature Recognition .
    The Global Feature Recognition dialog box appears.
    Note: The Axial Filter tab is activated only when Hole is selected in the Basic tab.
  2. Select the Axial Filter tab.
    1. Select the Apply Axial Filter check box.
      Axial Filters Parameters are now selectable.
    1. Select the check boxes corresponding to the required filters and specify the values.

      • Further parameters and values become available as you select the check boxes.
      • Diameter applies a filter on the hole diameter, that must either be equal to a given value or withing a specified range.
      • Depth applies a filter on the hole depth, that must either be equal to a given value or withing a specified range.
      • Extension applies a filter on the hole extension, as Blind or Through.
      • Hole Type applies a filter on the type of the hole:
      • Hole Threaded applies a filter on the thread of the hole via
        • The Thread Mode (Left or Right).
        • The Thread Dia (thread diameter) that must either be equal to a given value or withing a specified range.
        • Thread Depththat must either be equal to a given value or withing a specified range.
      Notes:
      • The filters use the actual diameter and actual depth of the hole, not the counter bore diameter/depth, counter sunk diameter/depth or counter drill diameter/depth.
      • The check boxes you have selected in the Axial Filter tab will be selected by default the next time you start Global Feature Recognition, but the corresponding values will be set to 0.

  3. Click OK in the Global Feature Recognition dialog box, then OK in the dialog box that appears to validate and exit the command.

    Tip: You can also click Apply, then OK in the dialog box that appears to validate without exiting the command.

    • The machinable axial features are recognized and created as MAF.x (with other features, see Creating Prismatic Machinable Features Globally for more information).
    • They are visible in the Manufacturing View (Sort by Patterns or Sort by Machining Features).
    • A dialog box opens and displays statistics about the recognized features, such as the number of faces, the number of holes found and their types, the number of pattern created, etc.

Edit Machinable Axial Features

You can edit a machinable axial feature as per your requirements without taking into consideration the geometry associated with it.

Notes:
  • As soon as you edit any parameter of the Machinable Axial Features, the associativity of the features with the geometry is lost and the automatic update mechanism ceases to work both in cases of re-recognition and the double-clicking of the Machinable Axial Features in the Manufacturing View.
  • Edition is possible only for machinable axial features which are not part of any pattern or operation.
  • You can edit several machinable axial features in one shot. If they are of different types, only their common parameters is edited. The other parameters are greyed out, the value shown being that of the first selected machinable axial feature. Revert to single edition to edit those parameters.

  1. Double-click a machinable axial feature in the Manufacturing View to check its parameters.
    An information dialog box opens.
    Note: The displayed information is read-only. Only the name of the machinable axial feature is editable.
  2. Right-click a machinable axial feature in the Manufacturing View and select Edit in the context menu that appears.
    The Machinable Axis Feature Edit dialog box appears with:
    • Mandatory Parameters.
      Notes:
      • They are available for edition only: You cannot perform, add or delete operations on these parameters.
      • If you change the Feature type, parameters are added or removed from the dialog box, according to the new type.
    • Thread Parameters
    • Tolerance parameters
    • User Parameters.
      Note: You cannot rename those parameters, nor change their type. You can edit their values or delete them.
  3. Edit the parameters as required, then click OK to validate and exit the dialog box.