-
From the
Create section of the
action bar,
click
Added
Feature
.
A
feature can have one of the following shape definitions:
Prism
,
Sweep
,
Revolve
,
Thick Surface
, or
External Shape
. For more Information, see
Working with Shape Definitions.
Prism
is selected as the default shape definition.
Note:
You can change the shape
definition.
The dialog box for the feature changes according to the
options offered by the shape.
-
Select the
profile you want to extrude.
- In the Limits tab under First Limit, select the type and enter the required parameters.
- Optional: Click Mirrored extent or under Second Limit, select the type and enter the required parameters.
- Optional:
Click
Preview.
- Optional:
Select the
Trim to shell check box.
The geometry outside of the shell volume is trimmed.
The feature not confined within the wall of
the deleted face of the shelled volume.
- Optional:
Under Thin Properties (available for prism, sweep, and revolve
shapes) select the Use param for thin feature check box, select a
reference element and enter the required thickness values ().
-
Select the Use param for thin feature check box to specify
the thin feature parameters.
-
From the Reference list, select a reference type.
-
Enter the inside and outside thickness values.
This option enables you to add material on both sides of the profile.
- Optional:
In the Draft tab,
-
From the Draft behavior list, select
Intrinsic to feature.
-
Set profile plane as the neutral element and enter the required value
to define the draft angle.
- Optional:
In the Fillet tab,
-
Select among the following check boxes and enter the required values,
to fillet the corresponding edges:
- Lateral radius to fillet lateral edges
- First radius to fillet top edges
- Second radius to fillet bottom edges
-
Select the Fillet profile ends check box, to
fillet the end faces of open sketches.
-
Select the Draft fillets check box, to fillet
the drafted edges.
-
From the Type list under Intersection
Fillet, select among the following, to create fillets at
required intersections:
- Intersection with Core/Cavity
- Intersection with Core
- Intersection with Cavity
-
Select the Fillet radius check box to create
fillet by adding material to the feature.
-
Select the Round radius check box to create
fillet by removing material from the feature.
-
Select the Preserve shell thickness check box to
maintain the thickness at fillets.
-
Click
OK.
Added Prism.x is added to the
tree
in the
Solid Functional Set.x node. The shell
properties are not inherited.
Note:
The core feature cannot be added to the added
feature. If you need to add a core feature, you need to use a
protected
feature.
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