-
Open the 3D part or Product to define.
-
From the
Component Definition section of the
action bar,
click
Define Component
.
- Any missing axis system or
Skeleton
is created.
- If the 3D Part or Product is recognized as a
Component,
its type is displayed (name and icon).
- The current axis system defines the
Hook
-
To edit the component type (if available), do one of the
following.
-
To apply or modify a type, click
and select one in the Types browser.
-
To remove a type, click
.
The type is removed but the 3D Part or Product remains a
Component.
-
Select
Create Axis System
in the dialog box to create one.
A new axis system is created and is
made current.
Note:
When working with an assembly
- You can create a
Hook
only in the
Skeleton.
- The selection of a
Hook
is not limited to the
Skeleton.
You can select an axis system in the whole structured product.
-
Select an axis system.
It is highlighted in the
work area.
-
In the
context toolbar:
-
Select
Reframe
to inspect the axis system.
-
Select
Replace
to make the selected axis system the current one.
Replace is
available only for the current axis system.
-
Expand Impacting Elements section.
See Impacting Geometry Types and Naming Rules
for more information.
Note:
When working with an
assembly, only the impacting elements of the current assembly child are
listed. Use List All Candidates to find impacting
elements in all the assembly children.
The table lists the possible Assembly Features, one per line.
- From left to right, each line is made of a check box, the type of
Assembly Feature, the name of the impacting element, the path of the impacting
element.
- By default, all the check boxes are selected.
-
When defining Cap Screws or Nuts from a 3Dpart, click Create Feature in the
dialog box or in the context toolbar to automatically define axis systems and Assembly Features.
For more information, see About Defining Screws and Nuts.
-
Click an arrow in a column header to filter the Assembly Features by type, name, or path.
-
Click Reset all to reset the filters.
-
Select check boxes, enter and apply a prefix to them.
Be careful not to apply several prefixes!
This helps filter them when creating impacts later on.
-
Select a body in the
work area,
or a check box in the dialog box.
It is highlighted, and a
context toolbar
appears.
-
In the
context toolbar
-
Expand the list of impact types, and select the type to apply.
The list of impacting elements is updated
accordingly.
-
Select
Reframe
to inspect the selected element.
-
Use
Select/Unselect
to activate or deactivate an
Assembly Feature
in the list.
-
Show all bodies
, or hide all bodies
or current one
.
The following data are created:
- For the Hook
- An axis system
- A publication (Base Axis System)
- For the Assembly Features
- Solid Functional Sets
- Protected Bodies
- Assembly Features
- Technological Results.
Note:
Components created without a type are supported by the following commands:
- Define Component
- Place Components
- Impacted by Components
- Impacts
- Delete Impacts (context menu)
- Delete Components (context menu)
They are not supported by:
- Move Several Components
- Move One Component
- Define Component Specifications.
The expected Component Specification type is User Component.