Generating Transition Paths

You can automatically generate a Transition Path.

Before you begin: Mill-turn and Lathe machines do not support Transition Path.
See Also
Creating and Editing Milling, Drilling, and Probing Tools
About Transition Paths
Activate the Generation of Transition Paths
Creating a Generic Machine and Managing Its Parameters
  1. Go to Me > Preferences > App Preferences > Simulation > Machining > NC Machining Apps Common Services > General and select the Show Transition Path Activity in Activities list check box in the General tab.
    Selecting this check box allows the display of the Transition Path activities in the Activities Process Tree.
  2. From any product:
    1. Select a machining app then the Programming section.
      An empty Manufacturing Cell is created with an Activities Process Tree.
    2. Create a generic machine or assign a machine from the database.
      As soon as a machine is assigned to the Manufacturing Cell, a Part Operation and a Manufacturing Program are created in the Activities Process Tree.
    3. Alternatively, open an existing Machining Process or PPR Context.

      By default, the Activities Process Tree is available.

  3. Create the tools you need.
  4. Optional: In the Part Operation, make sure the Activate the generation transition paths check box is selected, and that the traverse box, transition and rotary planes are defined.

    • Activate the generation transition paths is available only after you have selected a physical machine.
    • The selection of this check box allows the automatic generation of the Transition Path.

  5. Define a first Machining Operation, in our example, a Sweeping.
    A Transition Path is automatically created before the Machining Operation. Information about its status, and computation is displayed like for any Machining Operation.

    At this stage in our example, the Sweeping operation has been created but its tool path has not been computed, and the light status of the Transition Path is red because its tool path could not be generated.
    Note: If you right-click the Transition Path, you see that Compute Tool Path is not available in its context menu. The tool path of a Machining Operation must be computed to allow the generation of the tool path of its Transition Path.
  6. Right-click the Machining Operation and select Compute Tool Path in its context menu.

    Both the Machining Operation and the Transition Path tool paths are computed.

    Compute Tool Path is now available in the context menu of the Transition Path.
    Notes:
    • Computing (or re-computing) the tool path of a Machining Operation starts the computation (or re-computation) of that of the Transition Path.
    • However, computing the tool path of a Transition Path does not start the computation of the tool path of the Machining Operation.
    • The tool path of the Transition Path is also automatically computed when:
      • the Transition Path parameters are modified in the Part Operation,
      • a simulation is started,
      • a NC-output is generated.
      • the tool path of the Manufacturing Program is computed.
    • The tool path of a Transition Path is no longer up-to-date and must be recomputed when:
      • when the modification of a Machining Operation impacts the Transition Path activity (example, the first or the last point of the tool path of the Machining Operation has been modified.)
    • The tool path of a Transition Path is displayed as a dotted line.
    • The tool path of a Transition Path cannot be locked.
    • The tool path of a Transition Path cannot be modified with the Tool Path Editor. It can only be recomputed after a modification of its Machining Operation.