From the
Create section of the
action bar,
click
Rib
.
The
Rib.x dialog box appears.
In the
Profile/Surface box, select a
sketch or a surface.
Tip:
If no profile is defined, click
Positioned Sketch to sketch the profile.
The prism is the default shape. Click
Sweep if required.
Set the parameters and options to define the shape
as explained in
Prism.
To define limits, instead of using the
Length option, you can set the:
To Plane/Surface: The plane or surface
you then select trims the rib.
To Parting Element: The parting element
specified in the draft properties is used to set this limit. For this, you need
to define
Draft behavior in the
Draft tab.
Note:
It is not possible to select this option for defining
First length as well as
Second length at the same time.
To Neutral Element: The neutral element
specified in the draft properties is used set this limit.
Note:
You cannot select this option for defining
First length as well as
Second length at the same time.
Set one of the available options from the
Extension type list to define the extension
type.
No extension
confines the rib to be created only within the walls of
the shelled volume, even if the profile is outside of the walls of the volume.
Rib with Extension type set as No extension
From the
Type list, select
Enter thickness to define a thin pad.
After this option is selected, the
Thickness box becomes available. Wall
thickness values can only be positive values.
In the
Thickness box, enter a thickness value.
Select the
Neutral fiber check box.
The
Neutral fiber check box adds the same thickness to both sides of the
profile.
When you clear
Neutral fiber,
Thickness1 and
Thickness2 inputs are available. You can
give the different thickness to the left/right side of the profile, and one of
them can be 0mm.
in the Fillet tab, select First
radius and enter a value.
Important:
You can select the Draft fillets
check box. For more information, see draft
fillets.
Rib.x is added to the tree in the Solid Functional Set.x node.
.
to sketch the profile.
if required.
