Creating a Quick Clipping View/Quick Clipping View Profile

You can create a quick clipping view using a circle as callout. You can also use a roughly sketched profile.

Before you begin: Open a generative drawing representation. To specify that the dimensions which are attached to non-visible geometry in clipping views should be put in no show mode automatically, go to Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > View section, and select Put in no show dimension on non-visible geometry check box.
Note: This option is applicable only to Exact views.
See Also
About Clippings
Modifying a Clipping
  1. Perform either of the following operations in the View Layout section of the action bar:
    • To create a quick clipping view, click Quick Clipping View .
    • To create a quick clipping view using a sketched profile, click Quick Clipping View Profile .
    Note: In this scenario, you will create a quick clipping view.
  2. Perform either of the following operations:
    • If you are creating a quick clipping view, select the center of the circle.
    • If you are creating a quick clipping view using a sketched profile, click the required points to sketch a polygon.



  3. Perform either of the following operations:
    • If you are creating a quick clipping view, move the pointer to define the clipping profile and click to validate.
    • If you are creating a quick clipping view using a sketched profile, double-click to define the clipping profile.

    The quick clipping view and the associated profile result as shown here:



    Note: Note the existence of dimensions that are associated to a geometrical element which is not visible in the clipping view: these dimensions are placed in the no-show space. (When applicable, this is also the case of annotations that are associated to such a dimension, and of annotations that are no longer linked to the clipping view.) For more information, refer to View.

  4. From the View section of the action bar, click Swap visible space .

    You can now visualize the dimensions (and annotations, when applicable) that no longer appear on the clipping view.

    Important: Dimensions are displayed in clipping views using the colors defined in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > Drafting > Display tab, under Activate element's analysis. For more information, see Display.
  5. You can show these dimensions again on the clipping view. To do so, click Hide/Show in the View section.
    Important: You can also select View Definition > Unclip from the context menu. However, selecting this option will not show the dimensions on the unclipped view.
  6. Select the dimension you want to show on the clipping view.
  7. Click Swap visible space again.
    The selected dimension now appears on the quick clipping view again.