Creating Drafted Filleted Pockets

You can create a pocket while drafting its faces and filleting its edges. It is recommended to use this command to speed up your design.

Note: Depending on your role, you may not have access to this functionality.

Before you begin: Create a pad and sketch a closed profile on one of its faces.
See Also
Creating Pads
Creating Edge Fillets
Creating Basic Draft Features
Location of Sketches in the Tree (Hybrid Design)
  1. From the Model section of the action bar, click Drafted Filleted Pocket. .
  2. Select the profile to be extruded.


    The Drafted Filleted Pocket.x dialog box appears and the app previews the pocket to be created.

  3. In the First Limit box, enter the pocket depth value.
  4. In the Second Limit box, select the top face as the second limit.

    Selecting a second limit is mandatory.

    Your specifications for creating the pocket are now defined.
  5. In the Draft Angle box, enter the draft angle value.
    Note: If you do not want to draft the faces, clear the check box next to the Draft Angle box.
  6. Select Second limit to define the neutral element. So, note that the pad's top face is also used as the neutral element.
  7. Select the respective check boxes and enter a radius value for each edge type to define the three fillets as per the requirement.

    • Lateral radius: defines the fillets on vertical edges.

    • Top fillet radius: defines the round corner fillets.

    • Bottom fillet radius: defines the filets on the edges of the second limit.

    Note: If you do not want to fillet the edges, clear the respective check boxes.

If you look at the tree, you will note that you have created:

  • One pocket
  • One draft
  • Two fillets.

This implies that if you want to edit the drafted filleted pocket, you need to double-click the appropriate feature. This is your new 3D shape: