Creating a View From a 3D Plane, Face, or Sketch

You can create new design view from an existing 3D plane (whether or not this 3D plane is defined in the same representation as the view), a face, or a sketch.

Before you begin: Open a 3D shape representation containing a layout.
See Also
Views from a Reference Element
Changing the View Support
About View Callouts
Creating a View Using Generative View Styles
  1. From the View Layout section of the action bar, click View From Reference .
  2. Select the required option from the Tools Palette:
    OptionDescription
    Auxiliary View Creates an auxiliary view
    Section View Creates a section view
    Section Cut Creates a section cut
    Axonometric View Creates an axonometric view

    Create Datum: Right-click anywhere in the empty space and select Create Datum to create an isolated view. Leaving this option unselected creates an associative view whenever possible (if the view cannot be created associative, a specific mask is immediately displayed on the view icon in the tree to indicate non-associativity).

    Notes:
    • Isolated views cannot only be created from a 3D plane, a sketch or a 3D Tolerancing & Annotation view, but also from any object which is viewed as a 3D face (for example the face of a pad, or the sub-plane of an axis system).
    • When creating an isolated view, you can only use the existing reversed or rotated features of a plane as a support (for example, you cannot select the reversed orientation of a rotated plane). In this case, the XY orientation of a view created from a rotated plane is not guaranteed.
    • This option will be unavailable if you already selected a view support plane for which it is impossible to create an associative view.

  3. Select a plane from the tree or from the 3D area (the xy plane, for example).

    • You can also select a 3D plane created using the 3D Plane command.

      For more information, see Creating a 3D Plane.

    • You can also select a set which contains a plane. The view is created with the plane as its reference. When multiple planes are listed under a single set, the first plane is taken as reference.
    • When creating a view from a 3D plane, the new view origin point is superposed with the 3D plane origin point.
    • When creating a view from a planar face, the new view origin point is superposed to the {0,0,0} shape point projected on the planar face to ensure that the view origin is stable during face modification.
    • You can select any number of planes while the command is active, including the same reference plane.
    • You can also select a 2D view section for creation of a view. The view is created with the intersection plane of the 2D view section. For information on 2D view sections, see 3D Modeling: 3D Modeling Core: Generative Shape Design User's Guide: Creating 2D View Sections

    A new auxiliary view item is added to the tree.
  4. Click at the required location in the sheet to position the view.

    Note: The created view cannot be linked in position with another view.

    When you move the view for placement, the view stays aligned and oriented according to the preference selected in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > 2D Layout for 3D Design > View Creation, under View From Reference.

    That is, if the Align according to the active view (SHIFT toggles) and Set orientation according to the active view preferences are selected, then the following are considered for positioning the view:

    • The view can be moved either along the folding direction or perpendicularly to it. Both these directions are represented by two dashed lines.
    • The origin of the created view stays on the folding line containing its projection in the 3D background of the active view.
    • The view is oriented according to the current orientation of the active view.
    • You can also modify the 3D definition of the view plane in the View Creation dialog box to update the position and orientation of the view and make it consistent with the active view. This is unavailable for views created from 3D Tolerancing & Annotation views and captures.

    If these preferences are cleared, the view can be moved freely in the sheet.

    An empty view is created and added to the tree, displaying a blue axis in a red frame, as well as the view name and scale.

    When the view is created, if a geometric element is selected as a support for the view, the set containing it is automatically added to the created display filter. This can happen if the following criteria are satisfied:

    • The automatic creation of display filter is selected. To set the filter preferences, see Filter.
    • The filtering of the set containing the view support is selected.
    • The geometric element is inside the same 3D shape.

    Important:

    When you select several planes, the View Creation dialog box appears for each selected plane.

  5. In the View Creation dialog box, enter the required parameters.

    Note: If you select the Propagate scale from active view check box from Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > 2D Layout for 3D Design > View Creation, under View From Reference, the scale of the active view is followed.

    Click to activate or deactivate the scale editor.

  6. Optional: Select the Isolated check box to create an isolated view.

    By default, this check box is cleared.

    Note: Before creating the view, if you have selected Create Datum from the context menu, then the Isolated check box is already selected.

  7. Optional: Select the Reverse view direction check box.
    The direction of the view is reversed.
    Note: You can also isolate or reverse the view direction while changing the view support.
  8. Click OK to create the view.

The view is created and activated. You can select the preferences with respect to callouts for an auxiliary view, section view, or section-cut view in Me > Preferences > App Preferences > 3D Modeling > Mechanical Systems > 2D Layout for 3D Design > View Creation, under View From Reference:

  • To create the callout in active view
  • To change the callout overrun size
  • To create the callout for a non-perpendicular view
  • To change the color of the callout for a non-perpendicular view

For more information, see Display, View Creation, and Annotation and Dress-Up.