Creating a Parametric Section

You can create a single parametric section reference for one section family.

See Also
In Other Guides
Content for Structure Apps
  1. From the top bar, select Add > Content.
  2. Under the Structure category, click Structure Section .
    A new structure section reference is created.
  3. Sketch the profile of the section and define appropriate constraints. See Sketching Profiles for Structure Section.
  4. Create a simplified representation. See Creating a Simplified Representation.
  5. Create the section parameters and apply them to the constraints. See Section Parameters.
  6. Assign section keys to the profile. See Naming Section Edges.
  7. Define anchor points on the section.
  8. Create a design table and link it to the section. See Creating a Generic Section.
  9. Under the Parameters node,
    1. Create two sub-nodes, namely TemplateParameters and SectionParameters.
    2. Under the TemplateParameters node, create a parameter named Section Size.
    3. Under the SectionParameters node, add all the section parameters.
  10. Create a configuration rule using the Rule command in the Engineering Rules Capture app.
    For a given SectionSize template parameter value, the configuration rule identifies the corresponding row in the design table and assign the related parameter values to the section reference.

    Following is a sample configuration rule:

    let i (Integer)
let l (List)

i = 1

for i while i <= Relations\ L_Equal_Angles\Sheet  .RowsNb - 1
{
	l->Append(Relations\ L_Equal_Angles\Sheet ->CellAsString(i, 1))
}
`TemplateParameters\Section size`  .AuthorizedValues = l
Relations\ L_Equal_Angles\Configuration   =Relations\ L_Equal_Angles\Sheet    ->LocateInColumn(1, `TemplateParameters\Section size` )

  11. Change the sketch support to Isolated.
  12. Define a user feature using the User Feature command in the Part Design app.

    • In the Definition tab, specify the name of the user feature and add the following components:
      • SectionParameters
      • Relations
      • Sketch of the section
    • In the Inputs tab, the Section Size parameter appears as the input.
    • In the Outputs tab, the sketch of the section appears as the output.

    The user feature takes the Section Size parameter as input and updates the sketch as output.